diff --git a/src/regionModels/thermalBaffleModels/derivedFvPatchFields/thermalBaffle/thermalBaffleFvPatchScalarField.C b/src/regionModels/thermalBaffleModels/derivedFvPatchFields/thermalBaffle/thermalBaffleFvPatchScalarField.C
index 7739e403957c20aeda10c7b20c3ec5d5691ff168..9b2221a16fbb7b1241a1a9ddccae23433df4303e 100644
--- a/src/regionModels/thermalBaffleModels/derivedFvPatchFields/thermalBaffle/thermalBaffleFvPatchScalarField.C
+++ b/src/regionModels/thermalBaffleModels/derivedFvPatchFields/thermalBaffle/thermalBaffleFvPatchScalarField.C
@@ -6,6 +6,7 @@
\\/ M anipulation |
-------------------------------------------------------------------------------
Copyright (C) 2011-2016 OpenFOAM Foundation
+ Copyright (C) 2020 OpenCFD Ltd
-------------------------------------------------------------------------------
License
This file is part of OpenFOAM.
@@ -47,6 +48,7 @@ thermalBaffleFvPatchScalarField::thermalBaffleFvPatchScalarField
:
turbulentTemperatureRadCoupledMixedFvPatchScalarField(p, iF),
owner_(false),
+ internal_(true),
baffle_(),
dict_(dictionary::null),
extrudeMeshPtr_()
@@ -69,6 +71,7 @@ thermalBaffleFvPatchScalarField::thermalBaffleFvPatchScalarField
mapper
),
owner_(ptf.owner_),
+ internal_(ptf.internal_),
baffle_(),
dict_(ptf.dict_),
extrudeMeshPtr_()
@@ -84,6 +87,7 @@ thermalBaffleFvPatchScalarField::thermalBaffleFvPatchScalarField
:
turbulentTemperatureRadCoupledMixedFvPatchScalarField(p, iF, dict),
owner_(false),
+ internal_(true),
baffle_(),
dict_(dict),
extrudeMeshPtr_()
@@ -93,27 +97,27 @@ thermalBaffleFvPatchScalarField::thermalBaffleFvPatchScalarField
typedef regionModels::thermalBaffleModels::thermalBaffleModel baffle;
- if (thisMesh.name() == polyMesh::defaultRegion)
- {
- const word regionName = dict_.lookupOrDefault<word>("region", "none");
+ word regionName("none");
+ dict_.readIfPresent("region", regionName);
- const word baffleName("3DBaffle" + regionName);
+ dict_.readIfPresent("internal", internal_);
- if
- (
- !thisMesh.time().foundObject<fvMesh>(regionName)
- && regionName != "none"
- )
+ const word baffleName("3DBaffle" + regionName);
+
+ if
+ (
+ !thisMesh.time().foundObject<fvMesh>(regionName)
+ && regionName != "none"
+ )
+ {
+ if (extrudeMeshPtr_.empty())
{
- if (extrudeMeshPtr_.empty())
- {
- createPatchMesh();
- }
-
- baffle_.reset(baffle::New(thisMesh, dict).ptr());
- owner_ = true;
- baffle_->rename(baffleName);
+ createPatchMesh();
}
+
+ baffle_.reset(baffle::New(thisMesh, dict).ptr());
+ owner_ = true;
+ baffle_->rename(baffleName);
}
}
@@ -126,6 +130,7 @@ thermalBaffleFvPatchScalarField::thermalBaffleFvPatchScalarField
:
turbulentTemperatureRadCoupledMixedFvPatchScalarField(ptf, iF),
owner_(ptf.owner_),
+ internal_(ptf.internal_),
baffle_(),
dict_(ptf.dict_),
extrudeMeshPtr_()
@@ -170,7 +175,15 @@ void thermalBaffleFvPatchScalarField::createPatchMesh()
patchNames[topPatchID] = word("top");
patchTypes[bottomPatchID] = mappedWallPolyPatch::typeName;
- patchTypes[topPatchID] = mappedWallPolyPatch::typeName;
+
+ if (internal_)
+ {
+ patchTypes[topPatchID] = mappedWallPolyPatch::typeName;
+ }
+ else
+ {
+ patchTypes[topPatchID] = polyPatch::typeName;
+ }
if (dict_.get<bool>("columnCells"))
{
@@ -189,17 +202,24 @@ void thermalBaffleFvPatchScalarField::createPatchMesh()
wordList inGroups(1);
inGroups[0] = coupleGroup;
+ // The bottomPatchID is coupled with this patch
dicts[bottomPatchID].add("coupleGroup", coupleGroup);
dicts[bottomPatchID].add("inGroups", inGroups);
dicts[bottomPatchID].add("sampleMode", mpp.sampleModeNames_[mpp.mode()]);
+ dicts[bottomPatchID].add("samplePatch", patch().name());
+ dicts[bottomPatchID].add("sampleRegion", thisMesh.name());
- const word coupleGroupSlave =
- coupleGroup.substr(0, coupleGroup.find('_')) + "_slave";
+ // Internal baffle needs a coupled on the topPatchID
+ if (internal_)
+ {
+ const word coupleGroupSlave =
+ coupleGroup.substr(0, coupleGroup.find('_')) + "_slave";
- inGroups[0] = coupleGroupSlave;
- dicts[topPatchID].add("coupleGroup", coupleGroupSlave);
- dicts[topPatchID].add("inGroups", inGroups);
- dicts[topPatchID].add("sampleMode", mpp.sampleModeNames_[mpp.mode()]);
+ inGroups[0] = coupleGroupSlave;
+ dicts[topPatchID].add("coupleGroup", coupleGroupSlave);
+ dicts[topPatchID].add("inGroups", inGroups);
+ dicts[topPatchID].add("sampleMode", mpp.sampleModeNames_[mpp.mode()]);
+ }
forAll(regionPatches, patchi)
@@ -247,9 +267,7 @@ void thermalBaffleFvPatchScalarField::updateCoeffs()
return;
}
- const fvMesh& thisMesh = patch().boundaryMesh().mesh();
-
- if (owner_ && thisMesh.name() == polyMesh::defaultRegion)
+ if (owner_)
{
baffle_->evolve();
}
@@ -262,9 +280,7 @@ void thermalBaffleFvPatchScalarField::write(Ostream& os) const
{
turbulentTemperatureRadCoupledMixedFvPatchScalarField::write(os);
- const fvMesh& thisMesh = patch().boundaryMesh().mesh();
-
- if (owner_ && (thisMesh.name() == polyMesh::defaultRegion))
+ if (owner_)
{
os.writeEntry("extrudeModel", dict_.get<word>("extrudeModel"));
@@ -281,6 +297,8 @@ void thermalBaffleFvPatchScalarField::write(Ostream& os) const
os.writeEntry("region", dict_.get<word>("region"));
+ os.writeEntryIfDifferent<bool>("internal", true, internal_);
+
os.writeEntry("active", dict_.get<Switch>("active"));
os.writeKeyword("thermoType");
diff --git a/src/regionModels/thermalBaffleModels/derivedFvPatchFields/thermalBaffle/thermalBaffleFvPatchScalarField.H b/src/regionModels/thermalBaffleModels/derivedFvPatchFields/thermalBaffle/thermalBaffleFvPatchScalarField.H
index 088088e2d6f04e65548c8599f79c6ff4cd85d425..3637a77d883cae23729fb885c4bab4894e201ab5 100644
--- a/src/regionModels/thermalBaffleModels/derivedFvPatchFields/thermalBaffle/thermalBaffleFvPatchScalarField.H
+++ b/src/regionModels/thermalBaffleModels/derivedFvPatchFields/thermalBaffle/thermalBaffleFvPatchScalarField.H
@@ -6,6 +6,7 @@
\\/ M anipulation |
-------------------------------------------------------------------------------
Copyright (C) 2011-2017 OpenFOAM Foundation
+ Copyright (C) 2020 OpenCFD Ltd
-------------------------------------------------------------------------------
License
This file is part of OpenFOAM.
@@ -40,11 +41,53 @@ Description
The primary region creates the baffle region and evolves its energy
equation either:
- 1-D, normal to each patch face
- - 2-D, normal and tangential components
+ - 3-D, normal and tangential components
The thermodynamic properties of the baffle material are specified via
dictionary entries on the master patch.
+ The underlying polyPatch on the primary region needs to be defined
+ as a complete mappedWall. i.e:
+
+ \verbatim
+ type mappedWall;
+ sampleMode nearestPatchFace;
+ samplePatch <patchName>;
+ sampleRegion <regionName>;
+
+ coupleGroup <coupleGroupName>;
+
+ \endverbatim
+
+ The /keyword{internal} is true when the thermal baffle is used on internal
+ faces and the baffle is coupled on both sides (bottom and top).
+
+ If this baffle is used on a patch set internal = false. By default is
+ true.
+
+ \table
+ Property | Description | Required | Default value
+ Tnbr | name of the field | no | T
+ qrNbr | name of the radiative flux in the nbr region | no | none
+ qr | name of the radiative flux in this region | no | none
+ thicknessLayers | inherited from temperatureCoupledBase | inherited
+ kappaLayers | inherited from temperatureCoupledBase | inherited
+ kappaMethod | inherited from temperatureCoupledBase | inherited
+ kappa | inherited from temperatureCoupledBase | inherited
+ thermalInertia | Add thermal inertia to wall node | no | false
+ region | Name of the solid region | yes
+ active | Active | yes
+ internal | Is the baffle an internal regiion | no | true
+ thermoType | Solid thermo type | yes
+ mixture | Mixture solid | yes
+ radiation | Radiation model in the solid | yes
+ extrudeModel | Extrude model | yes
+ nLayers | Number of cell across the ragion | yes
+ expansionRatio | Expansion ratio for the solid region | yes
+ columnCells | true for 1D or false for 3D region | yes
+
+ \endtable
+
Usage
Example of the boundary condition specification:
\verbatim
@@ -61,8 +104,9 @@ Usage
value uniform 300;
// Baffle region name
- regionName baffleRegion;
+ region baffleRegion;
active yes;
+ internal yes;
// Solid thermo in solid region
thermoType
@@ -118,6 +162,9 @@ Usage
}
\endverbatim
+ If the thermal baffle is used on internal faces of the primary region,
+ then the slave in this region is defined as :
+
Slave patch on primary region:
\verbatim
<slavePatchName>
@@ -195,6 +242,9 @@ class thermalBaffleFvPatchScalarField
//- Is the baffle owner
bool owner_;
+ //- Is the baffle internal
+ bool internal_;
+
//- Thermal baffle
autoPtr<regionModels::thermalBaffleModels::thermalBaffleModel> baffle_;
diff --git a/src/regionModels/thermalBaffleModels/thermalBaffle/thermalBaffle.C b/src/regionModels/thermalBaffleModels/thermalBaffle/thermalBaffle.C
index 44422f683bc76239585fbf169a6512fb42a8565b..9533a415c6c6cfa65e687b840877395af24c1bc0 100644
--- a/src/regionModels/thermalBaffleModels/thermalBaffle/thermalBaffle.C
+++ b/src/regionModels/thermalBaffleModels/thermalBaffle/thermalBaffle.C
@@ -6,6 +6,7 @@
\\/ M anipulation |
-------------------------------------------------------------------------------
Copyright (C) 2011-2016 OpenFOAM Foundation
+ Copyright (C) 2020 OpenCFD Ltd.
-------------------------------------------------------------------------------
License
This file is part of OpenFOAM.
@@ -190,7 +191,7 @@ thermalBaffle::thermalBaffle
regionMesh().time().timeName(),
regionMesh(),
IOobject::READ_IF_PRESENT,
- IOobject::NO_WRITE
+ IOobject::AUTO_WRITE
),
regionMesh(),
dimensionedScalar(dimEnergy/dimVolume/dimTime, Zero)
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/T b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/T
new file mode 100644
index 0000000000000000000000000000000000000000..dae501dcf3bc9ad790ef8b79335fbbea04d5af8d
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/T
@@ -0,0 +1,119 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object T;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 0 0 1 0 0 0];
+
+internalField uniform 300;
+
+boundaryField
+{
+ floor
+ {
+ type zeroGradient;
+ }
+ ceiling
+ {
+
+ type compressible::thermalBaffle;
+
+ // Underlying coupled boundary condition
+ Tnbr T;
+ kappaMethod fluidThermo; // or solidThermo
+
+ qrNbr none;//or none.Name of qr field on neighbourregion
+ qr none;// or none.Name of qr field on localregion
+ value uniform 300;
+
+ // Baffle region name
+ region baffle3DRegion;
+ active yes;
+
+ // The baffle is extruded from this patch to the patch 'bottom'
+ // of the solid region.
+ internal no;
+
+ // Solid thermo in solid region
+ thermoType
+ {
+ type heSolidThermo;
+ mixture pureMixture;
+ transport constIso;
+ thermo hConst;
+ equationOfState rhoConst;
+ specie specie;
+ energy sensibleEnthalpy;
+ }
+
+ mixture
+ {
+ specie
+ {
+ molWeight 20;
+ }
+ transport
+ {
+ kappa 0.01;
+ }
+ thermodynamics
+ {
+ Hf 0;
+ Cp 15;
+ }
+ equationOfState
+ {
+ rho 80;
+ }
+ }
+
+ radiation
+ {
+ radiationModel opaqueSolid;
+ absorptionEmissionModel none;
+ scatterModel none;
+ }
+
+ // Extrude model for new region
+ extrudeModel linearNormal;
+ nLayers 50;
+ expansionRatio 1;
+ columnCells false; //3D
+ linearNormalCoeffs
+ {
+ thickness 0.1;
+ }
+
+
+ }
+ inlet
+ {
+ type fixedValue;
+ value uniform 300;
+ }
+ outlet
+ {
+ type inletOutlet;
+ inletValue uniform 300;
+ value uniform 300;
+ }
+ fixedWalls
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/U b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/U
new file mode 100644
index 0000000000000000000000000000000000000000..4620aaed388d7699d46f856e43a62a0aa5f1e57c
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/U
@@ -0,0 +1,56 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volVectorField;
+ location "0";
+ object U;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -1 0 0 0 0];
+
+internalField uniform (0 0 0);
+
+boundaryField
+{
+ #includeEtc "caseDicts/setConstraintTypes"
+
+ floor
+ {
+ type fixedValue;
+ value uniform (0 0 0);
+ }
+ ceiling
+ {
+ type fixedValue;
+ value uniform (0 0 0);
+ }
+ inlet
+ {
+ type fixedValue;
+ value uniform (0 0 0);
+ inletValue uniform (0 0 0);
+ }
+ outlet
+ {
+ type fixedValue;
+ inletValue uniform (0 0 0);
+ value uniform (0 0 0);
+ }
+ fixedWalls
+ {
+ type empty;
+ }
+
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/alphat b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/alphat
new file mode 100644
index 0000000000000000000000000000000000000000..6dc7b4d0ff5a741582b534eb273e9120a41ee378
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/alphat
@@ -0,0 +1,57 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object alphat;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [1 -1 -1 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ #includeEtc "caseDicts/setConstraintTypes"
+
+ floor
+ {
+ type compressible::alphatWallFunction;
+ Prt 0.85;
+ value uniform 0;
+ }
+ ceiling
+ {
+ type compressible::alphatWallFunction;
+ Prt 0.85;
+ value uniform 0;
+ }
+ inlet
+ {
+ type compressible::alphatWallFunction;
+ Prt 0.85;
+ value uniform 0;
+ }
+ outlet
+ {
+ type compressible::alphatWallFunction;
+ Prt 0.85;
+ value uniform 0;
+ }
+ fixedWalls
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/baffle3DRegion/T b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/baffle3DRegion/T
new file mode 100644
index 0000000000000000000000000000000000000000..45e8c8b4ced33cda05454cc37ef17225d56a8799
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/baffle3DRegion/T
@@ -0,0 +1,45 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object T;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 0 0 1 0 0 0];
+
+internalField uniform 300;
+
+boundaryField
+{
+ // This patch is the coupled with the ceiling in the fluid region
+ bottom
+ {
+ type compressible::thermalBaffle;
+ kappaMethod solidThermo;
+ value uniform 300;
+ }
+ side
+ {
+ type zeroGradient;
+ }
+
+ // This the external patch of the solid
+ top
+ {
+ type fixedValue;
+ value uniform 340;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/baffle3DRegion/p b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/baffle3DRegion/p
new file mode 100644
index 0000000000000000000000000000000000000000..5a239f0059c041e7b2781a87fc8def0e016c3961
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/baffle3DRegion/p
@@ -0,0 +1,31 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [1 -1 -2 0 0 0 0];
+
+internalField uniform 1e6;
+
+boundaryField
+{
+ ".*"
+ {
+ type zeroGradient;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/epsilon b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/epsilon
new file mode 100644
index 0000000000000000000000000000000000000000..30be6dd1301a2a73928a49283b918a298253ae33
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/epsilon
@@ -0,0 +1,65 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object epsilon;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -3 0 0 0 0];
+
+internalField uniform 0.01;
+
+boundaryField
+{
+ #includeEtc "caseDicts/setConstraintTypes"
+
+ floor
+ {
+ type epsilonWallFunction;
+ Cmu 0.09;
+ kappa 0.41;
+ E 9.8;
+ value uniform 0.01;
+ }
+ ceiling
+ {
+ type epsilonWallFunction;
+ Cmu 0.09;
+ kappa 0.41;
+ E 9.8;
+ value uniform 0.01;
+ }
+ inlet
+ {
+ type epsilonWallFunction;
+ Cmu 0.09;
+ kappa 0.41;
+ E 9.8;
+ value uniform 0.01;
+ }
+ outlet
+ {
+ type epsilonWallFunction;
+ Cmu 0.09;
+ kappa 0.41;
+ E 9.8;
+ value uniform 0.01;
+ }
+ fixedWalls
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/k b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/k
new file mode 100644
index 0000000000000000000000000000000000000000..a1989215fcf5eb97c0aa4be9303f353b2e8df586
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/k
@@ -0,0 +1,54 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object k;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 0.1;
+
+boundaryField
+{
+ #includeEtc "caseDicts/setConstraintTypes"
+
+ floor
+ {
+ type kqRWallFunction;
+ value uniform 0.1;
+ }
+ ceiling
+ {
+ type kqRWallFunction;
+ value uniform 0.1;
+ }
+ inlet
+ {
+ type kqRWallFunction;
+ value uniform 0.1;
+ }
+ outlet
+ {
+ type kqRWallFunction;
+ value uniform 0.1;
+ }
+ fixedWalls
+ {
+ type empty;
+ }
+
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/nut b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/nut
new file mode 100644
index 0000000000000000000000000000000000000000..8807ecb41eb496f773312ca47f4199283ec1b02d
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/nut
@@ -0,0 +1,66 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object nut;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ #includeEtc "caseDicts/setConstraintTypes"
+
+ floor
+ {
+ type nutkWallFunction;
+ Cmu 0.09;
+ kappa 0.41;
+ E 9.8;
+ value uniform 0;
+ }
+ ceiling
+ {
+ type nutkWallFunction;
+ Cmu 0.09;
+ kappa 0.41;
+ E 9.8;
+ value uniform 0;
+ }
+ inlet
+ {
+ type nutkWallFunction;
+ Cmu 0.09;
+ kappa 0.41;
+ E 9.8;
+ value uniform 0;
+ }
+ outlet
+ {
+ type nutkWallFunction;
+ Cmu 0.09;
+ kappa 0.41;
+ E 9.8;
+ value uniform 0;
+ }
+ fixedWalls
+ {
+ type empty;
+ }
+
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/p b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/p
new file mode 100644
index 0000000000000000000000000000000000000000..1ee0bcfd98b288ff50f958c9a9a293fb1936993d
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/p
@@ -0,0 +1,54 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [1 -1 -2 0 0 0 0];
+
+internalField uniform 101325;
+
+boundaryField
+{
+ #includeEtc "caseDicts/setConstraintTypes"
+
+ floor
+ {
+ type calculated;
+ value uniform 101325;
+ }
+ ceiling
+ {
+ type calculated;
+ value uniform 101325;
+ }
+ inlet
+ {
+ type calculated;
+ value uniform 101325;
+ }
+ outlet
+ {
+ type calculated;
+ value uniform 101325;
+ }
+ fixedWalls
+ {
+ type empty;
+ }
+
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/p_rgh b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/p_rgh
new file mode 100644
index 0000000000000000000000000000000000000000..9b25101cf93c4084a4f548488d82a4bf58fdf63c
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/0.orig/p_rgh
@@ -0,0 +1,50 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object p_rgh;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [1 -1 -2 0 0 0 0];
+
+internalField uniform 101325;
+
+boundaryField
+{
+ #includeEtc "caseDicts/setConstraintTypes"
+
+ floor
+ {
+ type fixedFluxPressure;
+ }
+ ceiling
+ {
+ type fixedFluxPressure;
+ }
+ inlet
+ {
+ type fixedFluxPressure;
+ }
+ outlet
+ {
+ type fixedFluxPressure;
+ }
+ fixedWalls
+ {
+ type empty;
+ }
+
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/Allclean b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/Allclean
new file mode 100755
index 0000000000000000000000000000000000000000..ee9650d03e7bde0ecc0950d91694a3216d445c27
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/Allclean
@@ -0,0 +1,10 @@
+#!/bin/sh
+cd "${0%/*}" || exit # Run from this directory
+. ${WM_PROJECT_DIR:?}/bin/tools/CleanFunctions # Tutorial clean functions
+#------------------------------------------------------------------------------
+
+cleanCase0
+
+rm -rf constant/baffle3DRegion
+
+#------------------------------------------------------------------------------
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/Allrun b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/Allrun
new file mode 100755
index 0000000000000000000000000000000000000000..31d94cec261cbe103e1e39f7e36739a0b7c8baa2
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/Allrun
@@ -0,0 +1,15 @@
+#!/bin/sh
+cd "${0%/*}" || exit # Run from this directory
+. ${WM_PROJECT_DIR:?}/bin/tools/RunFunctions # Tutorial run functions
+#------------------------------------------------------------------------------
+
+runApplication blockMesh
+
+restore0Dir
+
+# change to mapped BC the polyPatch
+runApplication changeDictionary
+
+runApplication $(getApplication)
+
+#------------------------------------------------------------------------------
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/constant/g b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/constant/g
new file mode 100644
index 0000000000000000000000000000000000000000..957ac3d14453360b9c6c86a41a99e83263869a8d
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/constant/g
@@ -0,0 +1,22 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class uniformDimensionedVectorField;
+ location "constant";
+ object g;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -2 0 0 0 0];
+value (0 -9.81 0);
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/constant/thermophysicalProperties b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/constant/thermophysicalProperties
new file mode 100644
index 0000000000000000000000000000000000000000..a2a275dbeb234b8e490a6067682c95f87392fbdb
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/constant/thermophysicalProperties
@@ -0,0 +1,48 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object thermophysicalProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+thermoType
+{
+ type heRhoThermo;
+ mixture pureMixture;
+ transport const;
+ thermo hConst;
+ equationOfState perfectGas;
+ specie specie;
+ energy sensibleEnthalpy;
+}
+
+mixture
+{
+ specie
+ {
+ molWeight 28.96;
+ }
+ thermodynamics
+ {
+ Cp 1004.4;
+ Hf 0;
+ }
+ transport
+ {
+ mu 1.831e-05;
+ Pr 0.705;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/constant/turbulenceProperties b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/constant/turbulenceProperties
new file mode 100644
index 0000000000000000000000000000000000000000..737ef960aeb443ddd80e51fa367e5edae6bd8e36
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/constant/turbulenceProperties
@@ -0,0 +1,29 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object turbulenceProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType RAS;
+
+RAS
+{
+ RASModel kEpsilon;
+
+ turbulence on;
+
+ printCoeffs on;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/baffle3DRegion/fvSchemes b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/baffle3DRegion/fvSchemes
new file mode 100644
index 0000000000000000000000000000000000000000..9238bf1ebb3bede6b460514b5b4182dc563379ab
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/baffle3DRegion/fvSchemes
@@ -0,0 +1,40 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system/baffleRegion";
+ object fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+ default steadyState;
+}
+
+divSchemes
+{
+ default none;
+}
+
+gradSchemes
+{
+ default Gauss linear;
+}
+
+laplacianSchemes
+{
+ default none;
+ laplacian(alpha,h) Gauss linear uncorrected;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/baffle3DRegion/fvSolution b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/baffle3DRegion/fvSolution
new file mode 100644
index 0000000000000000000000000000000000000000..e4e5499bcd974f514b281dc23b28c8215ed5f412
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/baffle3DRegion/fvSolution
@@ -0,0 +1,37 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system/baffleRegion";
+ object fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+ h
+ {
+ solver PCG;
+ smoother GaussSeidel;
+ preconditioner DIC;
+ tolerance 1e-06;
+ relTol 0;
+ }
+}
+
+nNonOrthCorr 0;
+
+relaxationFactors
+{
+ h 1;
+}
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/blockMeshDict b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/blockMeshDict
new file mode 100644
index 0000000000000000000000000000000000000000..67d503b253d04dd27415bc5764b3207ce7fb56db
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/blockMeshDict
@@ -0,0 +1,93 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+scale 0.1;
+
+vertices
+(
+ (0 0 0)
+ (10 0 0)
+ (10 5 0)
+ (0 5 0)
+ (0 0 1)
+ (10 0 1)
+ (10 5 1)
+ (0 5 1)
+);
+
+blocks
+(
+ hex (0 1 2 3 4 5 6 7) (50 40 1) simpleGrading (1 1 1)
+);
+
+edges
+(
+);
+
+boundary
+(
+ floor
+ {
+ type wall;
+ faces
+ (
+ (1 5 4 0)
+ );
+ }
+
+ ceiling
+ {
+ type wall;
+ faces
+ (
+ (2 6 7 3)
+ );
+ }
+
+ inlet
+ {
+ type wall;
+ faces
+ (
+ (0 4 7 3)
+ );
+ }
+
+ outlet
+ {
+ type wall;
+ faces
+ (
+ (1 5 6 2)
+ );
+ }
+
+ fixedWalls
+ {
+ type empty;
+ faces
+ (
+ (0 3 2 1)
+ (4 5 6 7)
+ );
+ }
+);
+
+mergePatchPairs
+(
+);
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/changeDictionaryDict b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/changeDictionaryDict
new file mode 100644
index 0000000000000000000000000000000000000000..fc69f53a16942ba352c72fd672bcc54e030bdeae
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/changeDictionaryDict
@@ -0,0 +1,36 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object changeDictionaryDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+
+
+ boundary
+ {
+ ceiling
+ {
+ type mappedWall;
+ sampleMode nearestPatchFace;
+ samplePatch bottom;
+ sampleRegion baffle3DRegion;
+ coupleGroup ceiling_baffle;
+
+ offsetMode uniform;
+ offset (0 0 0);
+ }
+ }
+
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/controlDict b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/controlDict
new file mode 100644
index 0000000000000000000000000000000000000000..ee573490061df9ee046724e60db534e662b48813
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/controlDict
@@ -0,0 +1,49 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object controlDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+application buoyantSimpleFoam;
+
+startFrom startTime;
+
+startTime 0;
+
+stopAt endTime;
+
+endTime 9000;
+
+deltaT 1;
+
+writeControl timeStep;
+
+writeInterval 500;
+
+purgeWrite 3;
+
+writeFormat ascii;
+
+writePrecision 6;
+
+writeCompression off;
+
+timeFormat general;
+
+timePrecision 6;
+
+runTimeModifiable true;
+
+libs (thermalBaffleModels);
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/fvSchemes b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/fvSchemes
new file mode 100644
index 0000000000000000000000000000000000000000..c8a2828c163b67d5beafcc515eb93ee9c78553f9
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/fvSchemes
@@ -0,0 +1,55 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+ default steadyState;
+}
+
+gradSchemes
+{
+ default Gauss linear;
+}
+
+divSchemes
+{
+ default none;
+ div(phi,U) bounded Gauss limitedLinear 0.2;
+ div(phi,K) bounded Gauss limitedLinear 0.2;
+ div(phi,h) bounded Gauss limitedLinear 0.2;
+ div(phi,k) bounded Gauss limitedLinear 0.2;
+ div(phi,epsilon) bounded Gauss limitedLinear 0.2;
+ div(phi,omega) bounded Gauss limitedLinear 0.2;
+ div(((rho*nuEff)*dev2(T(grad(U))))) Gauss linear;
+}
+
+laplacianSchemes
+{
+ default Gauss linear uncorrected;
+}
+
+interpolationSchemes
+{
+ default linear;
+}
+
+snGradSchemes
+{
+ default uncorrected;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/fvSolution b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/fvSolution
new file mode 100644
index 0000000000000000000000000000000000000000..ad6f1db2739262473aa66112a366fab168ae1a42
--- /dev/null
+++ b/tutorials/heatTransfer/buoyantSimpleFoam/roomWithThickCeiling/system/fvSolution
@@ -0,0 +1,66 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1906 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+ p_rgh
+ {
+ solver GAMG;
+ tolerance 1e-7;
+ relTol 0.01;
+
+ smoother DICGaussSeidel;
+
+ }
+
+ "(U|h|k|epsilon|omega)"
+ {
+ solver PBiCGStab;
+ preconditioner DILU;
+ tolerance 1e-7;
+ relTol 0.01;
+ }
+}
+
+SIMPLE
+{
+ momentumPredictor no;
+ nNonOrthogonalCorrectors 0;
+ pRefCell 0;
+ pRefValue 0;
+
+ residualControl
+ {
+ p_rgh 1e-3;
+ U 1e-4;
+ h 1e-4;
+
+ // possibly check turbulence fields
+ "(k|epsilon|omega)" 5e-3;
+ }
+}
+
+relaxationFactors
+{
+ p_rgh 0.7;
+ U 0.3;
+ h 0.8;
+ "(k|epsilon|omega)" 0.3;
+}
+
+
+// ************************************************************************* //