From 598c49fe8ada201aa8e423632d2cc19480e897e6 Mon Sep 17 00:00:00 2001
From: Andrew Heather <a.heather@opencfd.co.uk>
Date: Fri, 22 Jun 2018 15:25:06 +0100
Subject: [PATCH] TUT: Added new tutorial cases
---
.../LES/surfaceMountedCube/Allclean | 6 +
.../pimpleFoam/LES/surfaceMountedCube/Allrun | 11 +
.../pimpleFoam/LES/surfaceMountedCube/README | 17 ++
.../LES/surfaceMountedCube/fullCase/0/U | 55 ++++
.../LES/surfaceMountedCube/fullCase/0/k | 52 ++++
.../LES/surfaceMountedCube/fullCase/0/nuTilda | 52 ++++
.../LES/surfaceMountedCube/fullCase/0/nut | 49 ++++
.../LES/surfaceMountedCube/fullCase/0/p | 47 ++++
.../LES/surfaceMountedCube/fullCase/Allclean | 9 +
.../LES/surfaceMountedCube/fullCase/Allrun | 29 +++
.../fullCase/constant/transportProperties | 23 ++
.../fullCase/constant/turbulenceProperties | 40 +++
.../LES/surfaceMountedCube/fullCase/plot | 52 ++++
.../fullCase/system/blockMeshDict | 240 ++++++++++++++++++
.../fullCase/system/controlDict | 115 +++++++++
.../fullCase/system/decomposeParDict | 31 +++
.../fullCase/system/fvSchemes | 70 +++++
.../fullCase/system/fvSolution | 61 +++++
.../surfaceMountedCube/fullCase/system/sample | 125 +++++++++
.../LES/surfaceMountedCube/initChannel/0/U | 47 ++++
.../surfaceMountedCube/initChannel/0/epsilon | 49 ++++
.../LES/surfaceMountedCube/initChannel/0/k | 49 ++++
.../surfaceMountedCube/initChannel/0/nuTilda | 49 ++++
.../LES/surfaceMountedCube/initChannel/0/nut | 55 ++++
.../surfaceMountedCube/initChannel/Allclean | 8 +
.../LES/surfaceMountedCube/initChannel/Allrun | 9 +
.../initChannel/constant/transportProperties | 25 ++
.../initChannel/constant/turbulenceProperties | 30 +++
.../initChannel/system/blockMeshDict | 104 ++++++++
.../initChannel/system/controlDict | 85 +++++++
.../initChannel/system/fvSchemes | 59 +++++
.../initChannel/system/fvSolution | 56 ++++
.../simpleFoam/backwardFacingStep2D/0/U | 50 ++++
.../simpleFoam/backwardFacingStep2D/0/epsilon | 53 ++++
.../simpleFoam/backwardFacingStep2D/0/k | 53 ++++
.../simpleFoam/backwardFacingStep2D/0/nuTilda | 50 ++++
.../simpleFoam/backwardFacingStep2D/0/nut | 54 ++++
.../simpleFoam/backwardFacingStep2D/0/omega | 53 ++++
.../simpleFoam/backwardFacingStep2D/0/p | 50 ++++
.../simpleFoam/backwardFacingStep2D/Allclean | 10 +
.../simpleFoam/backwardFacingStep2D/Allrun | 100 ++++++++
.../simpleFoam/backwardFacingStep2D/README | 22 ++
.../constant/transportProperties | 22 ++
.../constant/turbulenceProperties | 30 +++
.../backwardFacingStep2D/system/blockMeshDict | 202 +++++++++++++++
.../backwardFacingStep2D/system/controlDict | 58 +++++
.../backwardFacingStep2D/system/fvSchemes | 59 +++++
.../backwardFacingStep2D/system/fvSolution | 60 +++++
.../system/pressureCoefficient | 14 +
.../backwardFacingStep2D/system/sample | 61 +++++
.../backwardFacingStep2D/system/sampleCp | 7 +
.../system/stressComponents | 6 +
.../turbulentFlatPlate/0.kEpsilon/U | 56 ++++
.../turbulentFlatPlate/0.kEpsilon/epsilon | 57 +++++
.../turbulentFlatPlate/0.kEpsilon/k | 59 +++++
.../turbulentFlatPlate/0.kEpsilon/nut | 60 +++++
.../turbulentFlatPlate/0.kEpsilon/p | 66 +++++
.../turbulentFlatPlate/0.kOmegaSST/U | 56 ++++
.../turbulentFlatPlate/0.kOmegaSST/k | 59 +++++
.../turbulentFlatPlate/0.kOmegaSST/nut | 60 +++++
.../turbulentFlatPlate/0.kOmegaSST/omega | 60 +++++
.../turbulentFlatPlate/0.kOmegaSST/p | 66 +++++
.../simpleFoam/turbulentFlatPlate/Allclean | 11 +
.../simpleFoam/turbulentFlatPlate/Allrun | 85 +++++++
.../simpleFoam/turbulentFlatPlate/README | 17 ++
.../constant/transportProperties | 22 ++
.../constant/turbulenceProperties-kEpsilon | 30 +++
.../constant/turbulenceProperties-kOmegaSST | 30 +++
.../constant/turbulenceProperties.orig | 28 ++
.../simpleFoam/turbulentFlatPlate/plot | 26 ++
.../turbulentFlatPlate/system/blockMeshDict | 133 ++++++++++
.../system/blockMeshDict.template | 133 ++++++++++
.../turbulentFlatPlate/system/controlDict | 68 +++++
.../system/decomposeParDict | 51 ++++
.../turbulentFlatPlate/system/fvSchemes | 60 +++++
.../turbulentFlatPlate/system/fvSolution | 84 ++++++
76 files changed, 4100 insertions(+)
create mode 100755 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/Allclean
create mode 100755 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/Allrun
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/README
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/U
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/k
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/nuTilda
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/nut
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/p
create mode 100755 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/Allclean
create mode 100755 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/Allrun
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/constant/transportProperties
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/constant/turbulenceProperties
create mode 100755 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/plot
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/blockMeshDict
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/controlDict
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/decomposeParDict
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/fvSchemes
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/fvSolution
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/sample
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/U
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/epsilon
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/k
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/nuTilda
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/nut
create mode 100755 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/Allclean
create mode 100755 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/Allrun
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/constant/transportProperties
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/constant/turbulenceProperties
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/blockMeshDict
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/controlDict
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/fvSchemes
create mode 100644 tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/fvSolution
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/U
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/epsilon
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/k
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/nuTilda
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/nut
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/omega
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/p
create mode 100755 tutorials/incompressible/simpleFoam/backwardFacingStep2D/Allclean
create mode 100755 tutorials/incompressible/simpleFoam/backwardFacingStep2D/Allrun
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/README
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/constant/transportProperties
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/constant/turbulenceProperties
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/blockMeshDict
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/controlDict
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/fvSchemes
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/fvSolution
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/pressureCoefficient
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/sample
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/sampleCp
create mode 100644 tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/stressComponents
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/U
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/epsilon
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/k
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/nut
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/p
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/U
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/k
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/nut
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/omega
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/p
create mode 100755 tutorials/incompressible/simpleFoam/turbulentFlatPlate/Allclean
create mode 100755 tutorials/incompressible/simpleFoam/turbulentFlatPlate/Allrun
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/README
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/transportProperties
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties-kEpsilon
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties-kOmegaSST
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties.orig
create mode 100755 tutorials/incompressible/simpleFoam/turbulentFlatPlate/plot
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/blockMeshDict
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/blockMeshDict.template
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/controlDict
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/decomposeParDict
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/fvSchemes
create mode 100644 tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/fvSolution
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/Allclean b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/Allclean
new file mode 100755
index 00000000000..77dcff4e4cd
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/Allclean
@@ -0,0 +1,6 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # run from this directory
+
+(cd initChannel && ./Allclean)
+(cd fullCase && ./Allclean)
+
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/Allrun b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/Allrun
new file mode 100755
index 00000000000..915160a56a3
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/Allrun
@@ -0,0 +1,11 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # run from this directory
+
+# Run a precursor channel flow to create a fully developed flow profile for the
+# main case
+(cd initChannel && ./Allrun)
+
+# Run the main case
+(cd fullCase && ./Allrun)
+
+
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/README b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/README
new file mode 100644
index 00000000000..f2d6bff7c51
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/README
@@ -0,0 +1,17 @@
+Unsteady flow over a surface mounted cube
+
+The set-up is based on the description given by Martinuzzi and Tropea:
+
+ R. Martinuzzi and C. Tropea. The Flow Around Surface-Mounted, Prismatic
+ Obstacles Placed in a Fully Developed Channel Flow. Journal of Fluids
+ Engineering, 115(1):85-92, 1993.
+
+where the Reynolds number based on the cube height is Re_h 40000.
+
+Turbulence is modelled using the Spalart-Allmaras Improved Delayed Detached
+Eddy Simulation (IDDES) model
+
+For further details please visit:
+
+ openfoam.com/documentation/cpp-guide/html/verification-validation-turbulent-surface-mounted-cube.html
+
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/U b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/U
new file mode 100644
index 00000000000..34b401fcb8a
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/U
@@ -0,0 +1,55 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volVectorField;
+ location "0";
+ object U;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -1 0 0 0 0];
+
+internalField uniform (0 0 0);
+
+boundaryField
+{
+ inlet
+ {
+// type timeVaryingMappedFixedValue;
+// offset (0 0 0);
+// setAverage off;
+ type turbulentDFSEMInlet;
+ delta 1;
+ nCellPerEddy 3;
+ mapMethod nearestCell;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type inletOutlet;
+ inletValue uniform (0 0 0);
+ value uniform (0 0 0);
+ }
+
+ sides
+ {
+ type slip;
+ }
+
+ "(cube|topAndBottom)"
+ {
+ type noSlip;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/k b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/k
new file mode 100644
index 00000000000..b0fd21471df
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/k
@@ -0,0 +1,52 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object k;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 1e-5;
+
+boundaryField
+{
+ inlet
+ {
+ type timeVaryingMappedFixedValue;
+ offset 0;
+ setAverage off;
+ mapMethod nearest;
+// type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ sides
+ {
+ type zeroGradient;
+ }
+
+ "(cube|topAndBottom)"
+ {
+ type fixedValue;
+ value uniform 0;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/nuTilda b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/nuTilda
new file mode 100644
index 00000000000..5b78f737aa3
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/nuTilda
@@ -0,0 +1,52 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object nuTilda;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 7.5e-5;
+
+boundaryField
+{
+ inlet
+ {
+ type timeVaryingMappedFixedValue;
+ offset 0;
+ setAverage off;
+ mapMethod nearest;
+// type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ sides
+ {
+ type zeroGradient;
+ }
+
+ "(cube|topAndBottom)"
+ {
+ type fixedValue;
+ value uniform 0;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/nut b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/nut
new file mode 100644
index 00000000000..3e2ffcc311c
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/nut
@@ -0,0 +1,49 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object nut;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ inlet
+ {
+ type calculated;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type calculated;
+ value $internalField;
+ }
+
+ sides
+ {
+ type zeroGradient;
+ }
+
+ "(cube|topAndBottom)"
+ {
+ type nutUSpaldingWallFunction;
+ value $internalField;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/p b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/p
new file mode 100644
index 00000000000..71430cf2377
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/0/p
@@ -0,0 +1,47 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ inlet
+ {
+ type zeroGradient;
+ }
+
+ outlet
+ {
+ type fixedValue;
+ value uniform 0;
+ }
+
+ sides
+ {
+ type zeroGradient;
+ }
+
+ "(cube|topAndBottom)"
+ {
+ type zeroGradient;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/Allclean b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/Allclean
new file mode 100755
index 00000000000..34abc6a364d
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/Allclean
@@ -0,0 +1,9 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # run from this directory
+
+# Source tutorial clean functions
+. $WM_PROJECT_DIR/bin/tools/CleanFunctions
+
+cleanCase
+\rm -rf constant/boundaryData *.png
+
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/Allrun b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/Allrun
new file mode 100755
index 00000000000..3f0efd48867
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/Allrun
@@ -0,0 +1,29 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # run from this directory
+
+# Source tutorial run functions
+. $WM_PROJECT_DIR/bin/tools/RunFunctions
+
+channelCase=../initChannel
+channelDataDir=$channelCase/postProcessing/surfaces/inlet
+
+[ -d $channelDataDir ] || {
+ echo "Unable to locate precursor channel case - exiting"
+ exit 1
+}
+
+# Copy the channel data
+# Note: this is mapped using a timeVaryingMapped condition on the inlet patch
+mkdir -p constant/boundaryData/inlet/0
+channelTimeDir=$(foamListTimes -case $channelCase -latestTime)
+
+\cp -rf $channelDataDir/points constant/boundaryData/inlet
+\cp -rf $channelDataDir/$channelTimeDir/turbulenceProperties:R constant/boundaryData/inlet/0/R
+\cp -rf $channelDataDir/$channelTimeDir/turbulenceProperties:L constant/boundaryData/inlet/0/L
+\cp -rf $channelDataDir/$channelTimeDir/turbulenceProperties:nuTilda constant/boundaryData/inlet/0/nuTilda
+\cp -rf $channelDataDir/$channelTimeDir/U constant/boundaryData/inlet/0/U
+
+runApplication blockMesh
+runApplication decomposePar
+runParallel $(getApplication)
+
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/constant/transportProperties b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/constant/transportProperties
new file mode 100644
index 00000000000..a5d64f2d655
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/constant/transportProperties
@@ -0,0 +1,23 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object transportProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+transportModel Newtonian;
+
+nu 2.5e-05;
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/constant/turbulenceProperties b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/constant/turbulenceProperties
new file mode 100644
index 00000000000..152018ed959
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/constant/turbulenceProperties
@@ -0,0 +1,40 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object RASProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType LES;
+
+LES
+{
+ turbulence on;
+
+ LESModel SpalartAllmarasIDDES;
+
+
+ printCoeffs on;
+
+ delta IDDESDelta;
+
+ IDDESDeltaCoeffs
+ {
+ hmax maxDeltaxyzCubeRoot;
+ maxDeltaxyzCubeRootCoeffs
+ {
+ }
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/plot b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/plot
new file mode 100755
index 00000000000..63f008e3c1b
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/plot
@@ -0,0 +1,52 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # run from this directory
+
+time=$1
+gnuplot<<EOF
+ set terminal pngcairo font "arial,16" size 600,600
+ set xlabel "U/U_b"
+ set ylabel "y/H"
+ set grid
+ set key right top
+ set xrange [-0.5:1.5]
+ set yrange [0:2]
+ Ub=1.10763
+ set output "U_at_x_by_hm10.png"
+ plot \
+ "postProcessing/sample/$time/xm10_U_UMean.xy" u (\$5/Ub):1 title "X/h = -1" w lines lc "black" lw 2
+ set output "U_at_x_by_hm05.png"
+ plot \
+ "postProcessing/sample/$time/xm05_U_UMean.xy" u (\$5/Ub):1 title "X/h = -0.5" w lines lc "black" lw 2
+ set output "U_at_x_by_00.png"
+ plot \
+ "postProcessing/sample/$time/x00_U_UMean.xy" u (\$5/Ub):1 title "X/h = 0" w lines lc "black" lw 2
+ set output "U_at_x_by_05.png"
+ plot \
+ "postProcessing/sample/$time/x05_U_UMean.xy" u (\$5/Ub):1 title "X/h = 0.5" w lines lc "black" lw 2
+ set output "U_at_x_by_10.png"
+ plot \
+ "postProcessing/sample/$time/x10_U_UMean.xy" u (\$5/Ub):1 title "X/h = 1" w lines lc "black" lw 2
+ set output "U_at_x_by_15.png"
+ plot \
+ "postProcessing/sample/$time/x15_U_UMean.xy" u (\$5/Ub):1 title "X/h = 1.5" w lines lc "black" lw 2
+ set output "U_at_x_by_20.png"
+ plot \
+ "postProcessing/sample/$time/x20_U_UMean.xy" u (\$5/Ub):1 title "X/h = 2" w lines lc "black" lw 2
+
+ set output "U_at_x_by_25.png"
+ plot \
+ "postProcessing/sample/$time/x25_U_UMean.xy" u (\$5/Ub):1 title "X/h = 2.5" w lines lc "black" lw 2
+
+ set output "U_at_x_by_30.png"
+ plot \
+ "postProcessing/sample/$time/x30_U_UMean.xy" u (\$5/Ub):1 title "X/h = 3" w lines lc "black" lw 2
+
+ set output "U_at_x_by_35.png"
+ plot \
+ "postProcessing/sample/$time/x35_U_UMean.xy" u (\$5/Ub):1 title "X/h = 3.5" w lines lc "black" lw 2
+
+ set output "U_at_x_by_40.png"
+ plot \
+ "postProcessing/sample/$time/x40_U_UMean.xy" u (\$5/Ub):1 title "X/h = 4" w lines lc "black" lw 2
+
+EOF
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/blockMeshDict b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/blockMeshDict
new file mode 100644
index 00000000000..a88b13b4edb
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/blockMeshDict
@@ -0,0 +1,240 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+scale 1;
+
+x_up 3.5;
+x_down 10;
+y_pad 4;
+z_pad 1;
+
+x0 0;
+x1 $x_up;
+x2 #calc "$x1 + 1";
+x3 #calc "$x2 + $x_down";
+
+y0 0;
+y1 $y_pad;
+y2 #calc "$y1 + 1";
+y3 #calc "$y2 + $y_pad";
+
+z0 0;
+z1 1;
+z2 #calc "$z1 + $z_pad";
+
+nx1 40;
+nx2 40;
+nx3 80;
+ny1 30;
+ny2 $nx2;
+ny3 $ny1;
+nz1 $nx2;
+nz2 40;
+
+vertices
+(
+ ($x0 $y0 $z0) // 0
+ ($x1 $y0 $z0) // 1
+ ($x2 $y0 $z0) // 2
+ ($x3 $y0 $z0) // 3
+ ($x0 $y0 $z1) // 4
+ ($x1 $y0 $z1) // 5
+ ($x2 $y0 $z1) // 6
+ ($x3 $y0 $z1) // 7
+ ($x0 $y0 $z2) // 8
+ ($x1 $y0 $z2) // 9
+ ($x2 $y0 $z2) // 10
+ ($x3 $y0 $z2) // 11
+
+ ($x0 $y1 $z0) // 12
+ ($x1 $y1 $z0) // 13
+ ($x2 $y1 $z0) // 14
+ ($x3 $y1 $z0) // 15
+ ($x0 $y1 $z1) // 16
+ ($x1 $y1 $z1) // 17
+ ($x2 $y1 $z1) // 18
+ ($x3 $y1 $z1) // 19
+ ($x0 $y1 $z2) // 20
+ ($x1 $y1 $z2) // 21
+ ($x2 $y1 $z2) // 22
+ ($x3 $y1 $z2) // 23
+
+ ($x0 $y2 $z0) // 24
+ ($x1 $y2 $z0) // 25
+ ($x2 $y2 $z0) // 26
+ ($x3 $y2 $z0) // 27
+ ($x0 $y2 $z1) // 28
+ ($x1 $y2 $z1) // 29
+ ($x2 $y2 $z1) // 30
+ ($x3 $y2 $z1) // 31
+ ($x0 $y2 $z2) // 32
+ ($x1 $y2 $z2) // 33
+ ($x2 $y2 $z2) // 34
+ ($x3 $y2 $z2) // 35
+
+ ($x0 $y3 $z0) // 36
+ ($x1 $y3 $z0) // 37
+ ($x2 $y3 $z0) // 38
+ ($x3 $y3 $z0) // 39
+ ($x0 $y3 $z1) // 40
+ ($x1 $y3 $z1) // 41
+ ($x2 $y3 $z1) // 42
+ ($x3 $y3 $z1) // 43
+ ($x0 $y3 $z2) // 44
+ ($x1 $y3 $z2) // 45
+ ($x2 $y3 $z2) // 46
+ ($x3 $y3 $z2) // 47
+);
+
+edges
+(
+);
+
+//x_up ((0.4 0.3 0.5)(0.6 0.7 1));
+//x_down ((0.4 0.75 1)(0.6 0.25 10));
+//z_top ((0.3 0.4 1)(0.7 0.6 2));
+//y_side1 ((0.6 0.4 0.25)(0.4 0.6 1));
+//y_side2 ((0.4 0.6 1)(0.6 0.4 4));
+
+x_up ((0.4 0.25 0.5)(0.3 0.25 0.75)(0.3 0.5 0.2));
+x_down ((0.15 0.45 3)(0.25 0.35 1.5)(0.6 0.2 5));
+z_top ((0.2 0.25 4)(0.6 0.5 1)(0.2 0.25 0.25));
+z_bottom ((0.2 0.25 4)(0.6 0.5 1)(0.2 0.25 0.25));
+y_side1 ((0.4 0.1 0.5)(0.4 0.2 0.5)(0.3 0.7 0.1));
+y_side2 ((0.3 0.7 10)(0.4 0.2 2)(0.4 0.1 2));
+
+blocks
+(
+ hex ( 0 1 13 12 4 5 17 16) ($nx1 $ny1 $nz1) simpleGrading ( $x_up $y_side1 $z_bottom)
+ hex ( 1 2 14 13 5 6 18 17) ($nx2 $ny1 $nz1) simpleGrading ( 1 $y_side1 $z_bottom)
+ hex ( 2 3 15 14 6 7 19 18) ($nx3 $ny1 $nz1) simpleGrading ($x_down $y_side1 $z_bottom)
+ hex ( 4 5 17 16 8 9 21 20) ($nx1 $ny1 $nz2) simpleGrading ( $x_up $y_side1 $z_top)
+ hex ( 5 6 18 17 9 10 22 21) ($nx2 $ny1 $nz2) simpleGrading ( 1 $y_side1 $z_top)
+ hex ( 6 7 19 18 10 11 23 22) ($nx3 $ny1 $nz2) simpleGrading ($x_down $y_side1 $z_top)
+
+ hex (12 13 25 24 16 17 29 28) ($nx1 $ny2 $nz1) simpleGrading ($x_up 1 $z_bottom)
+ //hex (13 14 26 25 17 18 30 29) ($nx2 $ny2 $nz1) simpleGrading (1 1 $z_bottom)
+ hex (14 15 27 26 18 19 31 30) ($nx3 $ny2 $nz1) simpleGrading ($x_down 1 $z_bottom)
+ hex (16 17 29 28 20 21 33 32) ($nx1 $ny2 $nz2) simpleGrading ($x_up 1 $z_top)
+ hex (17 18 30 29 21 22 34 33) ($nx2 $ny2 $nz2) simpleGrading (1 1 $z_top)
+ hex (18 19 31 30 22 23 35 34) ($nx3 $ny2 $nz2) simpleGrading ($x_down 1 $z_top)
+
+ hex (24 25 37 36 28 29 41 40) ($nx1 $ny3 $nz1) simpleGrading ($x_up $y_side2 $z_bottom)
+ hex (25 26 38 37 29 30 42 41) ($nx2 $ny3 $nz1) simpleGrading (1 $y_side2 $z_bottom)
+ hex (26 27 39 38 30 31 43 42) ($nx3 $ny3 $nz1) simpleGrading ($x_down $y_side2 $z_bottom)
+ hex (28 29 41 40 32 33 45 44) ($nx1 $ny3 $nz2) simpleGrading ($x_up $y_side2 $z_top)
+ hex (29 30 42 41 33 34 46 45) ($nx2 $ny3 $nz2) simpleGrading (1 $y_side2 $z_top)
+ hex (30 31 43 42 34 35 47 46) ($nx3 $ny3 $nz2) simpleGrading ($x_down $y_side2 $z_top)
+);
+
+boundary
+(
+ cube
+ {
+ type wall;
+ faces
+ (
+ (13 17 18 14)
+ (14 18 30 26)
+ (25 29 30 26)
+ (13 25 29 17)
+ (17 29 30 18)
+ );
+ }
+ topAndBottom
+ {
+ type wall;
+ faces
+ (
+ // floor
+ ( 0 12 13 1)
+ ( 1 13 14 2)
+ ( 2 14 15 3)
+ (12 24 25 13)
+ (14 26 27 15)
+ (24 36 37 25)
+ (25 37 38 26)
+ (26 38 39 27)
+
+ // top
+ ( 8 9 21 20)
+ ( 9 10 22 21)
+ (10 11 23 22)
+ (20 21 33 32)
+ (21 22 34 33)
+ (22 23 35 34)
+ (32 33 45 44)
+ (33 34 46 45)
+ (34 35 47 46)
+ );
+ }
+
+ sides
+ {
+ type patch;
+ faces
+ (
+ // minY
+ ( 0 1 5 4)
+ ( 1 2 6 5)
+ ( 2 3 7 6)
+ ( 4 5 9 8)
+ ( 5 6 10 9)
+ ( 6 7 11 10)
+
+ // maxY
+ (36 40 41 37)
+ (37 41 42 38)
+ (38 42 43 39)
+ (40 44 45 41)
+ (41 45 46 42)
+ (42 46 47 43)
+ );
+ }
+
+ inlet
+ {
+ type patch;
+ faces
+ (
+ ( 0 4 16 12)
+ (12 16 28 24)
+ (24 28 40 36)
+ ( 4 8 20 16)
+ (16 20 32 28)
+ (28 32 44 40)
+ );
+ }
+
+ outlet
+ {
+ type patch;
+ faces
+ (
+ ( 3 15 19 7)
+ (15 27 31 19)
+ (27 39 43 31)
+ ( 7 19 23 11)
+ (19 31 35 23)
+ (31 43 47 35)
+ );
+ }
+);
+
+mergePatchPairs
+(
+);
+
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/controlDict b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/controlDict
new file mode 100644
index 00000000000..13f27af8ab5
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/controlDict
@@ -0,0 +1,115 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object controlDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+libs ("libturbulenceModelSchemes.so");
+
+application pimpleFoam;
+
+startFrom startTime;
+
+startTime 0;
+
+stopAt endTime;
+
+endTime 100;
+
+deltaT 0.002;
+
+writeControl timeStep;
+
+writeInterval 100;
+
+purgeWrite 3;
+
+writeFormat binary;
+
+writePrecision 6;
+
+writeCompression off;
+
+timeFormat general;
+
+timePrecision 6;
+
+runTimeModifiable true;
+
+functions
+{
+ minMax
+ {
+ type fieldMinMax;
+ libs ("libfieldFunctionObjects.so");
+ fields (U p);
+ }
+ DESField
+ {
+ type DESModelRegions;
+ libs ("libfieldFunctionObjects.so");
+ //region "region0";
+ writeControl writeTime;
+ }
+ Q1
+ {
+ type Q;
+ libs ("libfieldFunctionObjects.so");
+ writeControl writeTime;
+ }
+ vorticity1
+ {
+ type vorticity;
+ libs ("libfieldFunctionObjects.so");
+ writeControl writeTime;
+ }
+ yPlus
+ {
+ type yPlus;
+ libs ("libfieldFunctionObjects.so");
+ writeControl writeTime;
+ }
+ fieldAverage1
+ {
+ type fieldAverage;
+ libs ("libfieldFunctionObjects.so");
+ writeControl writeTime;
+ timeStart 10;
+
+ fields
+ (
+ U
+ {
+ mean on;
+ prime2Mean on;
+ base time;
+ }
+
+ p
+ {
+ mean on;
+ prime2Mean on;
+ base time;
+ }
+ );
+ }
+
+ sample1
+ {
+ #include "sample"
+ }
+}
+
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/decomposeParDict b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/decomposeParDict
new file mode 100644
index 00000000000..6b91697e177
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/decomposeParDict
@@ -0,0 +1,31 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ note "mesh decomposition control dictionary";
+ object decomposeParDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+numberOfSubdomains 8;
+
+method hierarchical;
+
+
+hierarchicalCoeffs
+{
+ n (8 1 1);
+ // delta 0.001; //< default value = 0.001
+ // order xyz; //< default order = xyz
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/fvSchemes b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/fvSchemes
new file mode 100644
index 00000000000..db0d08b83e0
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/fvSchemes
@@ -0,0 +1,70 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+ default backward;
+}
+
+gradSchemes
+{
+ default leastSquares; // Gauss linear;
+}
+
+divSchemes
+{
+ default none;
+ div(phi,U) Gauss DEShybrid
+ linear // scheme 1
+ linearUpwind grad(U) // scheme 2
+ hmax
+ 0.65 // DES coefficient, typically = 0.65
+ 1 // Reference velocity scale
+ 1 // Reference length scale
+ 0 // Minimum sigma limit (0-1)
+ 1 // Maximum sigma limit (0-1)
+ 1; // 1.0e-03; // Limiter of B function, typically 1e-03
+// div(phi,U) Gauss LUST grad(U);// linear;
+ div(phi,k) Gauss limitedLinear 0.1;
+ div(phi,B) Gauss limitedLinear 0.1;
+ div(B) Gauss linear;
+ div(phi,nuTilda) Gauss limitedLinear 0.1;
+ div((nuEff*dev2(T(grad(U))))) Gauss linear;
+}
+
+laplacianSchemes
+{
+ default Gauss linear orthogonal;
+}
+
+interpolationSchemes
+{
+ default linear;
+}
+
+snGradSchemes
+{
+ default orthogonal;
+}
+
+wallDist
+{
+ method meshWave;
+ nRequired yes;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/fvSolution b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/fvSolution
new file mode 100644
index 00000000000..169f32d22bb
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/fvSolution
@@ -0,0 +1,61 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+ p
+ {
+ solver GAMG;
+ tolerance 0;
+ relTol 0.01;
+
+ smoother DICGaussSeidel;
+
+ }
+
+ pFinal
+ {
+ $p;
+ tolerance 1e-6;
+ relTol 0;
+ }
+
+ "(U|k|nuTilda)"
+ {
+ solver PBiCGStab;
+ preconditioner DILU;
+ tolerance 1e-8;
+ relTol 0.1;
+ }
+
+ "(U|k|nuTilda)Final"
+ {
+ $U;
+ tolerance 1e-06;
+ relTol 0;
+ }
+}
+
+PIMPLE
+{
+ nOuterCorrectors 3;
+ nCOrrectors 1;
+ nNonOrthogonalCorrectors 0;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/sample b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/sample
new file mode 100644
index 00000000000..c931230007a
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/fullCase/system/sample
@@ -0,0 +1,125 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object sample;
+}
+
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+type sets;
+libs ("libsampling.so");
+writeControl writeTime;
+
+interpolationScheme cellPoint;
+
+setFormat raw;
+
+sets
+(
+ xm10
+ {
+ type face;
+ axis z;
+ start (2.5 4.5 0);
+ end (2.5 4.5 2);
+ }
+ xm05
+ {
+ type face;
+ axis z;
+ start (3 4.5 0);
+ end (3 4.5 2);
+ }
+ x00
+ {
+ type face;
+ axis z;
+ start (3.5 4.5 1);
+ end (3.5 4.5 2);
+ }
+ x05
+ {
+ type face;
+ axis z;
+ start (4 4.5 1);
+ end (4 4.5 2);
+ }
+ x10
+ {
+ type face;
+ axis z;
+ start (4.5 4.5 1);
+ end (4.5 4.5 2);
+ }
+ x15
+ {
+ type face;
+ axis z;
+ start (5 4.5 0);
+ end (5 4.5 2);
+ }
+ x20
+ {
+ type face;
+ axis z;
+ start (5.5 4.5 0);
+ end (5.5 4.5 2);
+ }
+ x25
+ {
+ type face;
+ axis z;
+ start (6 4.5 0);
+ end (6 4.5 2);
+ }
+ x30
+ {
+ type face;
+ axis z;
+ start (6.5 4.5 0);
+ end (6.5 4.5 2);
+ }
+ x35
+ {
+ type face;
+ axis z;
+ start (7 4.5 0);
+ end (7 4.5 2);
+ }
+ x40
+ {
+ type face;
+ axis z;
+ start (7.5 4.5 0);
+ end (7.5 4.5 2);
+ }
+ x45
+ {
+ type face;
+ axis z;
+ start (8 4.5 0);
+ end (8 4.5 2);
+ }
+ x50
+ {
+ type face;
+ axis z;
+ start (8.5 4.5 0);
+ end (8.5 4.5 2);
+ }
+);
+
+fields (U UMean);
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/U b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/U
new file mode 100644
index 00000000000..42b47748f34
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/U
@@ -0,0 +1,47 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volVectorField;
+ location "0";
+ object U;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -1 0 0 0 0];
+
+internalField uniform (1 0 0);
+
+boundaryField
+{
+ lowerWall
+ {
+ type noSlip;
+ }
+ upperWall
+ {
+ type noSlip;
+ }
+ inlet
+ {
+ type cyclic;
+ }
+ outlet
+ {
+ type cyclic;
+ }
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/epsilon b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/epsilon
new file mode 100644
index 00000000000..fbf9122b877
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/epsilon
@@ -0,0 +1,49 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object epsilon;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -3 0 0 0 0];
+
+internalField uniform 180.18; // 10;
+
+boundaryField
+{
+ lowerWall
+ {
+ type fixedValue;
+ value uniform 1e-08;
+ }
+ upperWall
+ {
+ type fixedValue;
+ value uniform 1e-08;
+ }
+ inlet
+ {
+ type cyclic;
+ }
+ outlet
+ {
+ type cyclic;
+ }
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/k b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/k
new file mode 100644
index 00000000000..aa744945e57
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/k
@@ -0,0 +1,49 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object k;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 18.06; // 0.1;
+
+boundaryField
+{
+ lowerWall
+ {
+ type fixedValue;
+ value uniform 1e-10;
+ }
+ upperWall
+ {
+ type fixedValue;
+ value uniform 1e-10;
+ }
+ inlet
+ {
+ type cyclic;
+ }
+ outlet
+ {
+ type cyclic;
+ }
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/nuTilda b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/nuTilda
new file mode 100644
index 00000000000..f3befa054b1
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/nuTilda
@@ -0,0 +1,49 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object nuTilda;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ lowerWall
+ {
+ type fixedValue;
+ value uniform 0;
+ }
+ upperWall
+ {
+ type fixedValue;
+ value uniform 0;
+ }
+ inlet
+ {
+ type cyclic;
+ }
+ outlet
+ {
+ type cyclic;
+ }
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/nut b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/nut
new file mode 100644
index 00000000000..cca03bdd199
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/0/nut
@@ -0,0 +1,55 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object nut;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ lowerWall
+ {
+ type nutLowReWallFunction;
+ Cmu 0.09;
+ kappa 0.41;
+ E 9.8;
+ value uniform 0;
+ }
+ upperWall
+ {
+ type nutLowReWallFunction;
+ Cmu 0.09;
+ kappa 0.41;
+ E 9.8;
+ value uniform 0;
+ }
+ inlet
+ {
+ type cyclic;
+ }
+ outlet
+ {
+ type cyclic;
+ }
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/Allclean b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/Allclean
new file mode 100755
index 00000000000..e1c00032702
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/Allclean
@@ -0,0 +1,8 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # run from this directory
+
+# Source tutorial clean functions
+. $WM_PROJECT_DIR/bin/tools/CleanFunctions
+
+cleanCase
+
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/Allrun b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/Allrun
new file mode 100755
index 00000000000..5d65a383e2c
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/Allrun
@@ -0,0 +1,9 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # run from this directory
+
+# Source tutorial run functions
+. $WM_PROJECT_DIR/bin/tools/RunFunctions
+
+runApplication blockMesh
+runApplication $(getApplication)
+
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/constant/transportProperties b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/constant/transportProperties
new file mode 100644
index 00000000000..534a609d88d
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/constant/transportProperties
@@ -0,0 +1,25 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object transportProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+Ubar (1 0 0);
+
+transportModel Newtonian;
+
+nu 2.5e-05;
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/constant/turbulenceProperties b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/constant/turbulenceProperties
new file mode 100644
index 00000000000..5c0df177925
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/constant/turbulenceProperties
@@ -0,0 +1,30 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object turbulenceProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType RAS;
+
+RAS
+{
+ RASModel LaunderSharmaKE;
+
+ turbulence on;
+
+ printCoeffs on;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/blockMeshDict b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/blockMeshDict
new file mode 100644
index 00000000000..33d97b456f2
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/blockMeshDict
@@ -0,0 +1,104 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+scale 1;
+
+vertices
+(
+ (0 0 0)
+ (1 0 0)
+ (1 1 0)
+ (0 1 0)
+ (0 0 1)
+ (1 0 1)
+ (1 1 1)
+ (0 1 1)
+ (0 0 2)
+ (1 0 2)
+ (1 1 2)
+ (0 1 2)
+);
+
+blocks
+(
+ hex (0 1 2 3 4 5 6 7) (1 1 50) simpleGrading (1 1 100)
+ hex (4 5 6 7 8 9 10 11) (1 1 50) simpleGrading (1 1 0.01)
+);
+
+edges
+(
+);
+
+boundary
+(
+ lowerWall
+ {
+ type wall;
+ faces
+ (
+ (0 3 2 1)
+ );
+ }
+
+ upperWall
+ {
+ type wall;
+ faces
+ (
+ (8 9 10 11)
+ );
+ }
+
+ inlet
+ {
+ type cyclic;
+ neighbourPatch outlet;
+ faces
+ (
+ (0 4 7 3)
+ (4 8 11 7)
+ );
+ }
+
+ outlet
+ {
+ type cyclic;
+ neighbourPatch inlet;
+ faces
+ (
+ (1 2 6 5)
+ (5 6 10 9)
+ );
+ }
+
+ frontAndBack
+ {
+ type empty;
+ faces
+ (
+ (0 1 5 4)
+ (4 5 9 8)
+ (3 7 6 2)
+ (7 11 10 6)
+ );
+ }
+);
+
+mergePatchPairs
+(
+);
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/controlDict b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/controlDict
new file mode 100644
index 00000000000..e560ca3279e
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/controlDict
@@ -0,0 +1,85 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object controlDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+application boundaryFoam;
+
+startFrom startTime;
+
+startTime 0;
+
+stopAt endTime;
+
+endTime 2000;
+
+deltaT 1;
+
+writeControl timeStep;
+
+writeInterval 200;
+
+purgeWrite 1;
+
+writeFormat ascii;
+
+writePrecision 6;
+
+writeCompression off;
+
+timeFormat general;
+
+timePrecision 6;
+
+runTimeModifiable true;
+
+graphFormat raw;
+
+functions
+{
+ turbulenceFields
+ {
+ type turbulenceFields;
+ libs ("libfieldFunctionObjects.so");
+ writeControl writeTime;
+ fields (R nuTilda k epsilon omega L);
+ }
+
+ surfaces
+ {
+ type surfaces;
+ surfaceFormat boundaryData;
+ writeControl writeTime;
+ interpolationScheme cell;
+ fields
+ (
+ U
+ turbulenceProperties:R
+ turbulenceProperties:nuTilda
+ turbulenceProperties:L
+ );
+ surfaces
+ (
+ inlet
+ {
+ type patch;
+ patches (inlet);
+ interpolate false;
+ }
+ );
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/fvSchemes b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/fvSchemes
new file mode 100644
index 00000000000..8f391e5a790
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/fvSchemes
@@ -0,0 +1,59 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+ default steadyState;
+}
+
+gradSchemes
+{
+ default Gauss linear;
+}
+
+divSchemes
+{
+ default none;
+ div(phi,k) bounded Gauss linear;
+ div(phi,epsilon) bounded Gauss linear;
+ div(phi,R) bounded Gauss linear;
+ div(phi,nuTilda) bounded Gauss linear;
+ div((nuEff*dev2(T(grad(U))))) Gauss linear;
+}
+
+laplacianSchemes
+{
+ default none;
+ laplacian(nuEff,U) Gauss linear corrected;
+ laplacian(DkEff,k) Gauss linear corrected;
+ laplacian(DepsilonEff,epsilon) Gauss linear corrected;
+ laplacian(DREff,R) Gauss linear corrected;
+ laplacian(DnuTildaEff,nuTilda) Gauss linear corrected;
+}
+
+interpolationSchemes
+{
+ default linear;
+}
+
+snGradSchemes
+{
+ default corrected;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/fvSolution b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/fvSolution
new file mode 100644
index 00000000000..b02316f6d7a
--- /dev/null
+++ b/tutorials/incompressible/pimpleFoam/LES/surfaceMountedCube/initChannel/system/fvSolution
@@ -0,0 +1,56 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+ U
+ {
+ solver PCG;
+ preconditioner DIC;
+ tolerance 1e-06;
+ relTol 0;
+ }
+
+ "(k|epsilon|R|nuTilda)"
+ {
+ solver smoothSolver;
+ smoother symGaussSeidel;
+ tolerance 1e-06;
+ relTol 0;
+ }
+}
+
+PISO
+{
+ nCorrectors 2;
+ nNonOrthogonalCorrectors 0;
+}
+
+relaxationFactors
+{
+ equations
+ {
+ U 0.5;
+ k 0.7;
+ epsilon 0.7;
+ R 0.7;
+ nuTilda 0.7;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/U b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/U
new file mode 100644
index 00000000000..39625411d45
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/U
@@ -0,0 +1,50 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volVectorField;
+ object U;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -1 0 0 0 0];
+
+internalField uniform (1e-8 0 0);
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value uniform (44.2 0 0);
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ "(lowerWallStartup|upperWallStartup)"
+ {
+ type symmetryPlane;
+ }
+
+ "(upperWall|lowerWall)"
+ {
+ type noSlip;
+ }
+
+ "(front|back)"
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/epsilon b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/epsilon
new file mode 100644
index 00000000000..4b4727722a9
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/epsilon
@@ -0,0 +1,53 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object epsilon;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -3 0 0 0 0];
+
+internalField uniform 17.83;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ "(lowerWallStartup|upperWallStartup)"
+ {
+ type symmetryPlane;
+ }
+
+ "(upperWall|lowerWall)"
+ {
+ type epsilonWallFunction;
+ value $internalField;
+ }
+
+ "(front|back)"
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/k b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/k
new file mode 100644
index 00000000000..193a7911528
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/k
@@ -0,0 +1,53 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object k;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 1.09e-3; // 0.061%
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ "(lowerWallStartup|upperWallStartup)"
+ {
+ type symmetryPlane;
+ }
+
+ "(upperWall|lowerWall)"
+ {
+ type kqRWallFunction;
+ value $internalField;
+ }
+
+ "(front|back)"
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/nuTilda b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/nuTilda
new file mode 100644
index 00000000000..70089cdc187
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/nuTilda
@@ -0,0 +1,50 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object nuTilda;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ "(lowerWallStartup|upperWallStartup)"
+ {
+ type symmetryPlane;
+ }
+
+ "(upperWall|lowerWall)"
+ {
+ type zeroGradient;
+ }
+
+ "(front|back)"
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/nut b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/nut
new file mode 100644
index 00000000000..e27074faa3e
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/nut
@@ -0,0 +1,54 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object nut;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ inlet
+ {
+ type calculated;
+ value uniform 0;
+ }
+
+ outlet
+ {
+ type calculated;
+ value uniform 0;
+ }
+
+ "(lowerWallStartup|upperWallStartup)"
+ {
+ type symmetryPlane;
+ }
+
+ "(upperWall|lowerWall)"
+ {
+ type nutUBlendedWallFunction;
+ value uniform 0;
+ }
+
+ "(front|back)"
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/omega b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/omega
new file mode 100644
index 00000000000..d6150e3cc44
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/omega
@@ -0,0 +1,53 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object omega;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 0 -1 0 0 0 0];
+
+internalField uniform 181728;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ "(lowerWallStartup|upperWallStartup)"
+ {
+ type symmetryPlane;
+ }
+
+ "(upperWall|lowerWall)"
+ {
+ type omegaWallFunction;
+ value $internalField;
+ }
+
+ "(front|back)"
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/p b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/p
new file mode 100644
index 00000000000..e5aabf7898e
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/0/p
@@ -0,0 +1,50 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ inlet
+ {
+ type zeroGradient;
+ }
+
+ outlet
+ {
+ type fixedValue;
+ value uniform 0;
+ }
+
+ "(lowerWallStartup|upperWallStartup)"
+ {
+ type symmetryPlane;
+ }
+
+ "(upperWall|lowerWall)"
+ {
+ type zeroGradient;
+ }
+
+ "(front|back)"
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/Allclean b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/Allclean
new file mode 100755
index 00000000000..71f48f6a4e8
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/Allclean
@@ -0,0 +1,10 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # run from this directory
+
+# Source tutorial clean functions
+. $WM_PROJECT_DIR/bin/tools/CleanFunctions
+
+cleanCase
+
+\rm -rf *.dat *.png
+
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/Allrun b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/Allrun
new file mode 100755
index 00000000000..fb5696959da
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/Allrun
@@ -0,0 +1,100 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # run from this directory
+
+# Source tutorial run functions
+. $WM_PROJECT_DIR/bin/tools/RunFunctions
+
+runApplication blockMesh
+runApplication simpleFoam
+
+if notTest $@
+then
+ # Create validation plots
+
+ # Test if gnuplot exists on the system
+ command -v gnuplot >/dev/null 2>&1 || {
+ echo "gnuplot not found - skipping graph creation" 1>&2
+ exit 1
+ }
+
+ # Copy results to the validation directory
+ timeDir=$(foamListTimes -latestTime)
+ sampleDir=postProcessing/sample/$timeDir
+
+ [ -d $sampleDir ] || {
+ echo "results directory not found - skipping graph creation" 1>&2
+ exit 1
+ }
+
+ # Test if awk exists on the system
+ command -v awk >/dev/null 2>&1 || {
+ echo "awk not found - skipping graph creation" 1>&2
+ exit 1
+ }
+
+ Uref=$(awk '{print $2}' $sampleDir/Uref_U.xy)
+
+ graphNameU="backwardStep2D_U.png"
+
+ echo "Creating U profiles graph to $graphNameU"
+ gnuplot<<EOF1
+ set terminal pngcairo font "helvetica,20" size 1000, 1000
+
+ set xrange [-0.4:1.2]
+ set yrange [0:3]
+ set xlabel "U/U_0"
+ set ylabel "y/h"
+ set grid
+ set output "$graphNameU"
+
+ href = 0.0127
+ Uref = $Uref
+
+ set lmargin 7.5
+ set rmargin 1.5
+ set tmargin 0.1
+ set bmargin 3.2
+ set key top left
+
+ set format x "%.1f"
+ set format y "%.1f"
+
+ plot \
+ "$sampleDir/x_by_h_01_U.xy" u (\$2/Uref):(\$1/href) w lines lw 2 lc rgb "red" t "x/h = 1", \
+ "$sampleDir/x_by_h_04_U.xy" u (\$2/Uref):(\$1/href) w lines lw 2 lc rgb "green" t "x/h = 4", \
+ "$sampleDir/x_by_h_06_U.xy" u (\$2/Uref):(\$1/href) w lines lw 2 lc rgb "blue" t "x/h = 6", \
+ "$sampleDir/x_by_h_10_U.xy" u (\$2/Uref):(\$1/href) w lines lw 2 lc rgb "black" t "x/h = 10"
+EOF1
+
+ echo "# ccx tau_xx tau_yy tau_zz" > tauw.dat
+ foamDictionary -entry boundaryField.lowerWall.value -value $timeDir/Cx | \
+ sed -n '/(/,/)/p' | sed -e 's/[()]//g;/^\s*$/d' > Cx.$$
+ foamDictionary -entry boundaryField.lowerWall.value -value $timeDir/wallShearStress | \
+ sed -n '/(/,/)/p' | sed -e 's/[()]//g;/^\s*$/d' > tau.$$
+ paste -d ' ' Cx.$$ tau.$$ >> tauw.dat
+ \rm -f Cx.$$ tau.$$
+
+ graphNameTau="backwardStep2D_tau.png"
+ echo "Creating wallshear stress graph to $graphNameTau"
+ gnuplot<<EOF2
+ set terminal pngcairo font "helvetica,20" size 1000, 1000
+ set xrange [-5:30]
+ set yrange [-0.002:0.004]
+ set grid
+ set key bottom right
+ set xlabel "x/h"
+ set ylabel "c_f"
+ set output "$graphNameTau"
+
+ Uref = $Uref
+ href = 0.0127
+
+ set lmargin 10
+ set rmargin 1.5
+ set tmargin 0.1
+ set bmargin 3.2
+
+ plot "tauw.dat" u (\$1/href):(-\$2/(0.5*Uref*Uref)) t "simpleFoam" w l lw 2 lc rgb "black"
+EOF2
+fi
+
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/README b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/README
new file mode 100644
index 00000000000..8971d4754cd
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/README
@@ -0,0 +1,22 @@
+Steady flow over a 2D backward facing step
+
+This canonical case is based on the description by Driver and Seegmiller
+
+ D.M. Driver and H.L. Seegmiller. Features of a reattaching turbulent shear
+ layer in divergent channel flow. AIAA Journal, 23(2):163–171, 1985.
+
+where the mesh is based on the Langley Research Center Turbulence Modeling
+Resource set-up provided at:
+
+ https://turbmodels.larc.nasa.gov/backstep_val.html
+
+The Reynolds number based on the step height is Reh 36000 for which the
+stated reattachment length is at 6.26 +/- 0.1 x/h
+
+The Allrun script will run the case and generate graphs showing the wall
+shear stress and velocity profiles at various cross-sections.
+
+For further information please visit:
+
+ openfoam.com/documentation/cpp-guide/html/verification-validation-turbulent-backward-facing-step.html
+
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/constant/transportProperties b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/constant/transportProperties
new file mode 100644
index 00000000000..dd9ace28826
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/constant/transportProperties
@@ -0,0 +1,22 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object transportProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+transportModel Newtonian;
+
+nu 1.56e-05;
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/constant/turbulenceProperties b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/constant/turbulenceProperties
new file mode 100644
index 00000000000..2b5ce67ef68
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/constant/turbulenceProperties
@@ -0,0 +1,30 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object turbulenceProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType RAS;
+
+RAS
+{
+ RASModel kOmegaSST; // kEpsilon;
+
+ turbulence on;
+
+ printCoeffs on;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/blockMeshDict b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/blockMeshDict
new file mode 100644
index 00000000000..aad6d42bfc2
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/blockMeshDict
@@ -0,0 +1,202 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+scale 0.0127;
+
+vertices
+(
+ ( -130 1 1) // 0
+ ( -110 1 1) // 1
+ ( 0 1 1) // 2
+ ( 0 0 1) // 3
+ ( 8 0 1) // 4
+ ( 50 0 1) // 5
+ ( 8 1 1) // 6
+ ( 50 3.125 1) // 7
+ ( 50 9 1) // 8
+ ( 8 9 1) // 9
+ ( 0 9 1) // 10
+ ( -110 9 1) // 11
+ ( -130 9 1) // 12
+
+ ( -130 1 0) // 13
+ ( -110 1 0) // 14
+ ( 0 1 0) // 15
+ ( 0 0 0) // 16
+ ( 8 0 0) // 17
+ ( 50 0 0) // 18
+ ( 8 1 0) // 19
+ ( 50 3.125 0) // 20
+ ( 50 9 0) // 21
+ ( 8 9 0) // 22
+ ( 0 9 0) // 23
+ ( -110 9 0) // 24
+ ( -130 9 0) // 25
+);
+
+
+ySpacing ((0.3 0.47 250)(0.2 0.06 1)(0.3 0.47 0.004));
+ySpacing2 ((0.75 0.3 1)(0.25 0.7 0.004));
+yWall ((0.5 0.5 100)(0.5 0.5 0.03));
+
+yLower1 ((0.4 0.7 50)(0.6 0.3 1));
+yLower2 ((1 1 50));
+
+//yUpper1 ((0.1 0.15 2)(0.75 0.35 4)(0.25 0.5 0.005));
+yUpper1 ((0.1 0.2 2)(0.75 0.35 5)(0.25 0.45 0.005));
+
+blocks
+(
+ // Coarse
+
+ // Block 0
+ hex (13 14 24 25 0 1 11 12)
+ (2 65 1)
+ simpleGrading (0.3 $ySpacing 1)
+
+ // Block 1
+ hex (14 15 23 24 1 2 10 11)
+ (88 65 1)
+ simpleGrading (((106 63 0.1)(4 25 0.3)) $ySpacing 1)
+
+ // Block 2
+ hex (16 17 19 15 3 4 6 2)
+ (97 48 1)
+// simpleGrading (1 1 1)
+ edgeGrading (1 1 1 1 $yWall $yLower1 $yLower1 $yWall 1 1 1 1)
+
+ // Block 3
+ hex (17 18 20 19 4 5 7 6)
+ (33 48 1)
+// simpleGrading (100 1 1)
+ edgeGrading (80 80 80 80 $yLower1 $yLower2 $yLower2 $yLower1 1 1 1 1)
+
+ // Block 4
+ hex (15 19 22 23 2 6 9 10)
+ (97 65 1)
+// simpleGrading (1 $ySpacing 1)
+ edgeGrading (1 1 1 1 $ySpacing $yUpper1 $yUpper1 $ySpacing 1 1 1 1)
+
+ // Block 5
+ hex (19 20 21 22 6 7 8 9)
+ (33 65 1)
+// simpleGrading (100 $ySpacing 1)
+ edgeGrading (80 80 80 80 $yUpper1 $ySpacing2 $ySpacing2 $yUpper1 1 1 1 1)
+/*
+ // fine
+ hex (0 1 9 8 7 6 14 15)
+ (800 1 100)
+ simpleGrading (1 1 200)
+
+ hex (2 3 11 10 1 4 12 9)
+ (400 1 150)
+ simpleGrading (((1 10 5)(1 1 10)) 1 ((1 1 10 )(1 1 0.1)))
+
+ hex (1 4 12 9 6 5 13 14)
+ (400 1 100)
+ simpleGrading (((1 10 5)(1 1 10)) 1 200)
+*/
+);
+
+edges
+(
+);
+
+boundary
+(
+ inlet
+ {
+ type patch;
+ faces
+ (
+ (13 0 12 25)
+ );
+ }
+ outlet
+ {
+ type patch;
+ faces
+ (
+ (18 20 7 5)
+ (20 21 8 7)
+ );
+ }
+ lowerWallStartup
+ {
+ type symmetryPlane;
+ faces
+ (
+ (13 14 1 0)
+ );
+ }
+ upperWallStartup
+ {
+ type symmetryPlane;
+ faces
+ (
+ (25 12 11 24)
+ );
+ }
+ upperWall
+ {
+ type wall;
+ faces
+ (
+ (24 11 10 23)
+ (23 10 9 22)
+ (22 9 8 21)
+ );
+ }
+ lowerWall
+ {
+ type wall;
+ faces
+ (
+ (14 15 2 1)
+ (15 2 3 16)
+ (16 17 4 3)
+ (17 18 5 4)
+ );
+ }
+ front
+ {
+ type empty;
+ faces
+ (
+ (0 1 11 12)
+ (1 2 10 11)
+ (3 4 6 2)
+ (4 5 7 6)
+ (2 6 9 10)
+ (6 7 8 9)
+ );
+ }
+ back
+ {
+ type empty;
+ faces
+ (
+ (13 25 24 14)
+ (14 24 23 15)
+ (16 15 19 17)
+ (17 19 20 18)
+ (15 23 22 19)
+ (19 22 21 20)
+ );
+ }
+);
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/controlDict b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/controlDict
new file mode 100644
index 00000000000..4c98c5c9aca
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/controlDict
@@ -0,0 +1,58 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object controlDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+application simpleFoam;
+
+startFrom startTime;
+
+startTime 0;
+
+stopAt endTime;
+
+endTime 2000;
+
+deltaT 1;
+
+writeControl timeStep;
+
+writeInterval 100;
+
+purgeWrite 5;
+
+writeFormat ascii;
+
+writePrecision 6;
+
+writeCompression off;
+
+timeFormat general;
+
+timePrecision 6;
+
+runTimeModifiable true;
+
+functions
+{
+ #includeFunc "stressComponents"
+ #includeFunc "pressureCoefficient"
+ #includeFunc "sample"
+ #includeFunc "sampleCp"
+ #includeFunc "writeCellCentres"
+ #includeFunc "wallShearStress"
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/fvSchemes b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/fvSchemes
new file mode 100644
index 00000000000..831cd1cfd1c
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/fvSchemes
@@ -0,0 +1,59 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+ default steadyState;
+}
+
+gradSchemes
+{
+ default Gauss linear;
+}
+
+divSchemes
+{
+ default none;
+ div(phi,U) bounded Gauss LUST grad(U);
+ div(phi,k) bounded Gauss limitedLinear 1;
+ div(phi,epsilon) bounded Gauss limitedLinear 1;
+ div(phi,omega) bounded Gauss limitedLinear 1;
+ div((nuEff*dev2(T(grad(U))))) Gauss linear;
+}
+
+laplacianSchemes
+{
+ default Gauss linear corrected;
+}
+
+interpolationSchemes
+{
+ default linear;
+}
+
+snGradSchemes
+{
+ default corrected;
+}
+
+wallDist
+{
+ method meshWave;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/fvSolution b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/fvSolution
new file mode 100644
index 00000000000..ab10d99b045
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/fvSolution
@@ -0,0 +1,60 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+ p
+ {
+ solver GAMG;
+ tolerance 1e-10;
+ relTol 0.1;
+ smoother DICGaussSeidel;
+ }
+
+ "(U|k|epsilon|omega)"
+ {
+ solver smoothSolver;
+ smoother symGaussSeidel;
+ tolerance 1e-10;
+ relTol 0.1;
+ }
+}
+
+SIMPLE
+{
+ nNonOrthogonalCorrectors 0;
+ consistent yes;
+
+ residualControl
+ {
+ p 1e-4;
+ U 1e-6;
+ "(k|epsilon|omega|f|v2)" 1e-5;
+ }
+}
+
+relaxationFactors
+{
+ equations
+ {
+ U 0.9;
+ ".*" 0.8;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/pressureCoefficient b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/pressureCoefficient
new file mode 100644
index 00000000000..5a24f95419d
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/pressureCoefficient
@@ -0,0 +1,14 @@
+type pressure;
+libs ("libfieldFunctionObjects.so");
+
+writeControl writeTime;
+
+calcCoeff yes;
+calcTotal no;
+
+result cp;
+
+rho rhoInf;
+rhoInf 1;
+pInf 0;
+UInf (44.2 0 0);
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/sample b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/sample
new file mode 100644
index 00000000000..08690f754fc
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/sample
@@ -0,0 +1,61 @@
+type sets;
+libs ("libsampling.so");
+
+writeControl writeTime;
+
+interpolationScheme cellPoint;
+
+setFormat raw;
+
+sets
+(
+ Uref
+ {
+ type cloud;
+ axis y;
+ points ((-0.0508 0.0508 0.01));
+ }
+
+ x_by_h_m04
+ {
+ type face;
+ axis y;
+ start (-0.0508 -0.0127 0);
+ end (-0.0508 0.1016 0);
+ nPoints 100;
+ }
+ x_by_h_01
+ {
+ type face;
+ axis y;
+ start (0.0127 -0.0127 0);
+ end (0.0127 0.1016 0);
+ nPoints 100;
+ }
+ x_by_h_04
+ {
+ type face;
+ axis y;
+ start (0.0508 -0.0127 0);
+ end (0.0508 0.1016 0);
+ nPoints 100;
+ }
+ x_by_h_06
+ {
+ type face;
+ axis y;
+ start (0.0762 -0.0127 0);
+ end (0.0762 0.1016 0);
+ nPoints 100;
+ }
+ x_by_h_10
+ {
+ type face;
+ axis y;
+ start (0.127 -0.0127 0);
+ end (0.127 0.1016 0);
+ nPoints 100;
+ }
+);
+
+fields (p U turbulenceProperties:devReff);
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/sampleCp b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/sampleCp
new file mode 100644
index 00000000000..6d29221fce0
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/sampleCp
@@ -0,0 +1,7 @@
+type patchProbes;
+libs ("libsampling.so");
+writeControl writeTime;
+
+patch lowerWall;
+probeLocations ();
+fields (cp);
diff --git a/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/stressComponents b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/stressComponents
new file mode 100644
index 00000000000..1c83aaa3c99
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/backwardFacingStep2D/system/stressComponents
@@ -0,0 +1,6 @@
+type turbulenceFields;
+libs ("libfieldFunctionObjects.so");
+
+writeControl writeTime;
+
+fields (devReff);
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/U b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/U
new file mode 100644
index 00000000000..495d5b8ffca
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/U
@@ -0,0 +1,56 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volVectorField;
+ object U;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -1 0 0 0 0];
+
+internalField uniform (69.4 0 0);
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ topWall
+ {
+ type slip;
+ }
+
+ bottomWall
+ {
+ type fixedValue;
+ value uniform (0 0 0);
+ }
+
+ symmetry
+ {
+ type symmetryPlane;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/epsilon b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/epsilon
new file mode 100644
index 00000000000..790f83fc64d
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/epsilon
@@ -0,0 +1,57 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object epsilon;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -3 0 0 0 0];
+
+internalField uniform 0.84321; // from kOmega model epsilon=omega*k*Cmu
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ topWall
+ {
+ type zeroGradient;
+ }
+
+ bottomWall
+ {
+ type epsilonWallFunction;
+ lowReCorrection on;
+ value $internalField;
+ }
+
+ symmetry
+ {
+ type symmetryPlane;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/k b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/k
new file mode 100644
index 00000000000..5f2ea6da438
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/k
@@ -0,0 +1,59 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object k;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 1.08e-3; // 1.08e-3 = 1.125*(69.4)^2/5e6 // 11=3.9% 18.1=5%;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+
+// type turbulentIntensityKineticEnergyInlet;
+// intensity 0.05; // 5% turbulence
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ topWall
+ {
+ type zeroGradient;
+ }
+
+ bottomWall
+ {
+ type kqRWallFunction;
+ value $internalField;
+ }
+
+ symmetry
+ {
+ type symmetryPlane;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/nut b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/nut
new file mode 100644
index 00000000000..b296d6eeaef
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/nut
@@ -0,0 +1,60 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object nut;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 1.25e-7;
+
+boundaryField
+{
+ inlet
+ {
+ type calculated;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type calculated;
+ value $internalField;
+ }
+
+ topWall
+ {
+ type calculated;
+ value $internalField;
+ }
+
+ bottomWall
+ {
+ type nutkWallFunction;
+ value $internalField;
+ }
+
+ symmetry
+ {
+ type symmetryPlane;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/p b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/p
new file mode 100644
index 00000000000..7f43b34e0c1
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kEpsilon/p
@@ -0,0 +1,66 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ inlet
+ {
+ type zeroGradient;
+/*
+ type totalPressure;
+ rho none;
+ psi none;
+ p0 uniform 1.02828;
+ value uniform 1.02828;
+*/
+ }
+
+ outlet
+ {
+ type fixedValue;
+ value uniform 0;
+/*
+ type fixedValue;
+ value uniform 1;
+*/
+ }
+
+ topWall
+ {
+ type zeroGradient;
+ }
+
+ bottomWall
+ {
+ type zeroGradient;
+ }
+
+ symmetry
+ {
+ type symmetryPlane;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/U b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/U
new file mode 100644
index 00000000000..495d5b8ffca
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/U
@@ -0,0 +1,56 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volVectorField;
+ object U;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -1 0 0 0 0];
+
+internalField uniform (69.4 0 0);
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ topWall
+ {
+ type slip;
+ }
+
+ bottomWall
+ {
+ type fixedValue;
+ value uniform (0 0 0);
+ }
+
+ symmetry
+ {
+ type symmetryPlane;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/k b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/k
new file mode 100644
index 00000000000..5f2ea6da438
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/k
@@ -0,0 +1,59 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object k;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 1.08e-3; // 1.08e-3 = 1.125*(69.4)^2/5e6 // 11=3.9% 18.1=5%;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+
+// type turbulentIntensityKineticEnergyInlet;
+// intensity 0.05; // 5% turbulence
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ topWall
+ {
+ type zeroGradient;
+ }
+
+ bottomWall
+ {
+ type kqRWallFunction;
+ value $internalField;
+ }
+
+ symmetry
+ {
+ type symmetryPlane;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/nut b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/nut
new file mode 100644
index 00000000000..bbe63243e24
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/nut
@@ -0,0 +1,60 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object nut;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 1.25e-7;
+
+boundaryField
+{
+ inlet
+ {
+ type calculated;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type calculated;
+ value $internalField;
+ }
+
+ topWall
+ {
+ type calculated;
+ value $internalField;
+ }
+
+ bottomWall
+ {
+ type nutUSpaldingWallFunction;
+ value $internalField;
+ }
+
+ symmetry
+ {
+ type symmetryPlane;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/omega b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/omega
new file mode 100644
index 00000000000..80b827502ae
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/omega
@@ -0,0 +1,60 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object omega;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 0 -1 0 0 0 0];
+
+internalField uniform 8675; // 8675=125*69.4/1 ; // 0.011;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+
+// type turbulentMixingLengthFrequencyInlet;
+// mixingLength 1;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type zeroGradient;
+ }
+
+ topWall
+ {
+ type zeroGradient;
+ }
+
+ bottomWall
+ {
+ type omegaWallFunction;
+ blended true;
+ value $internalField;
+ }
+
+ symmetry
+ {
+ type symmetryPlane;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/p b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/p
new file mode 100644
index 00000000000..7f43b34e0c1
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/0.kOmegaSST/p
@@ -0,0 +1,66 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ inlet
+ {
+ type zeroGradient;
+/*
+ type totalPressure;
+ rho none;
+ psi none;
+ p0 uniform 1.02828;
+ value uniform 1.02828;
+*/
+ }
+
+ outlet
+ {
+ type fixedValue;
+ value uniform 0;
+/*
+ type fixedValue;
+ value uniform 1;
+*/
+ }
+
+ topWall
+ {
+ type zeroGradient;
+ }
+
+ bottomWall
+ {
+ type zeroGradient;
+ }
+
+ symmetry
+ {
+ type symmetryPlane;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/Allclean b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/Allclean
new file mode 100755
index 00000000000..447b72d0f30
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/Allclean
@@ -0,0 +1,11 @@
+#!/bin/bash
+#set -x
+
+cd ${0%/*} || exit 1
+
+. $WM_PROJECT_DIR/bin/tools/CleanFunctions
+
+cleanCase
+
+\rm -rf 0 postProcessing-*
+\rm -f *.dat *.png constant/turbulenceProperties
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/Allrun b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/Allrun
new file mode 100755
index 00000000000..e9ff1929802
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/Allrun
@@ -0,0 +1,85 @@
+#!/bin/sh
+cd ${0%/*} || exit 1
+
+# Source tutorial run functions
+. $WM_PROJECT_DIR/bin/tools/RunFunctions
+
+if notTest $@
+then
+ models="
+ kOmegaSST
+ kEpsilon
+ "
+
+ declare -A grading_vs_yp
+ #level 5 gradings
+ grading_vs_yp[0.05]=50000
+ grading_vs_yp[1]=2200
+ grading_vs_yp[2]=950
+ grading_vs_yp[5]=300
+ grading_vs_yp[10]=130
+ grading_vs_yp[30]=30
+ grading_vs_yp[50]=15
+ grading_vs_yp[100]=5
+
+ # level 3 gradings
+ #grading_vs_yp[1]=9300
+ #grading_vs_yp[2]=4300
+ #grading_vs_yp[5]=1500
+ #grading_vs_yp[10]=650
+ #grading_vs_yp[30]=175
+ #grading_vs_yp[50]=90
+ #grading_vs_yp[100]=35
+
+ \cp constant/turbulenceProperties.orig constant/turbulenceProperties
+
+ for model in $models
+ do
+ echo "Processing model: $model"
+
+ runApplication -s $model foamDictionary -entry RAS.RASModel -set $model constant/turbulenceProperties
+
+ for i in "${!grading_vs_yp[@]}"
+ do
+ yp=$i
+ grading=${grading_vs_yp[$yp]}
+
+ echo "Mesh: y+ $yp"
+
+ \rm -rf 0 [1-9]*
+ \cp -rf 0.${model} 0
+
+ sed "s/GRADING/$grading/g" system/blockMeshDict.template > system/blockMeshDict
+
+ runApplication -s ${model}_${yp} blockMesh
+
+ runApplication -s ${model}_${yp} simpleFoam
+
+ UInf=$(foamDictionary -entry internalField 0/U | sed 's/^.*(\s*\([^ ]*\).*/\1/g')
+ nuInf=$(foamDictionary -entry nu constant/transportProperties | sed 's/^.*\s\(.*\);/\1/g')
+
+ timeDir=$(foamListTimes -latestTime)
+
+ echo "UInf = $UInf"
+
+ foamDictionary -entry boundaryField.bottomWall.value -value $timeDir/Cx | \
+ sed -n '/(/,/)/p' | sed -e 's/[()]//g;/^\s*$/d' > Cx.$$
+ foamDictionary -entry boundaryField.bottomWall.value -value $timeDir/wallShearStress | \
+ sed -n '/(/,/)/p' | sed -e 's/[()]//g;/^\s*$/d' > tau.$$
+ foamDictionary -entry boundaryField.bottomWall.value -value $timeDir/yPlus | \
+ sed -n '/(/,/)/p' | sed -e 's/[()]//g;/^\s*$/d' > yp.$$
+
+ echo "# ccx tau_xx tau_yy tau_zz" > tauw_${model}_${yp}.dat
+ paste -d ' ' Cx.$$ tau.$$ >> tauw_${model}_${yp}.dat
+ echo "# ccx y+" > yplus_${model}_${yp}.dat
+ paste -d ' ' Cx.$$ yp.$$ >> yplus_${model}_${yp}.dat
+ \rm -f Cx.$$ tau.$$ yp.$$
+
+ ./plot $UInf $nuInf $model $yp
+
+ # Optionally store the results
+ #mv $timeDir ${model}_${yp}.${timeDir}
+ done
+ mv postProcessing postProcessing-${model}
+ done
+fi
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/README b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/README
new file mode 100644
index 00000000000..2d89236ab3c
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/README
@@ -0,0 +1,17 @@
+Steady flow over a 2D flat plate
+
+This case is based on the zero pressure gradient flat plate test described
+by the Langley Research Center Turbulence Modeling Resource provided at:
+
+ https://turbmodels.larc.nasa.gov/flatplate.html
+
+The Reynolds number based on the plate length is of Re_L = 5×10^6
+
+The Allrun script applies a selection of tubulence models to a range of y+
+meshes which for which graphs are created that compare the predictions
+against the data from Weighardt.
+
+For further information please visit:
+
+ openfoam.com/documentation/cpp-guide/html/verification-validation-turbulent-flat-plate-zpg.html
+
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/transportProperties b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/transportProperties
new file mode 100644
index 00000000000..73759f9481c
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/transportProperties
@@ -0,0 +1,22 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object transportProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+transportModel Newtonian;
+
+nu 1.388e-05;
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties-kEpsilon b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties-kEpsilon
new file mode 100644
index 00000000000..8fe9b5ed38d
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties-kEpsilon
@@ -0,0 +1,30 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object turbulenceProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType RAS;
+
+RAS
+{
+ RASModel kEpsilon;
+
+ turbulence on;
+
+ printCoeffs on;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties-kOmegaSST b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties-kOmegaSST
new file mode 100644
index 00000000000..8b2ee153c16
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties-kOmegaSST
@@ -0,0 +1,30 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object turbulenceProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType RAS;
+
+RAS
+{
+ RASModel kOmegaSST;
+
+ turbulence on;
+
+ printCoeffs on;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties.orig b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties.orig
new file mode 100644
index 00000000000..6558e655e64
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/constant/turbulenceProperties.orig
@@ -0,0 +1,28 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object turbulenceProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType RAS;
+
+RAS
+{
+ RASModel xxx;
+ turbulence on;
+ printCoeffs on;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/plot b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/plot
new file mode 100755
index 00000000000..63e451a6d99
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/plot
@@ -0,0 +1,26 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # run from this directory
+
+Uinf=$1
+nuInf=$2
+model=$3
+yp=$4
+gnuplot<<EOF
+ set terminal pngcairo font "arial,16" size 800,600
+ set output "OF_${model}_YP${yp}.png"
+ set xlabel "Re_x"
+ set ylabel "Cf"
+ set grid
+ set key right top
+ set xrange [0:1e7]
+ set yrange [0:0.006]
+ UInf = $Uinf
+ nuInf = $nuInf
+ X0 = 0 # Location of start of plate
+ laminar(x) = 0.664/(sqrt(x)) # Blasius - laminar
+ weighardt(x) = 0.288*(log10(x))**(-2.45) # turbulent
+ plot \
+ weighardt(x) t "Weighardt" w lines lc "red" lw 2, \
+ "tauw_${model}_${yp}.dat" u (\$1 - X0)*UInf/nuInf:(sqrt(\$2*\$2 + \$3*\$3 + \$4*\$4)/(0.5*UInf*UInf)) title "$model y^+ ${yp}" w lines lc "black" lw 2
+
+EOF
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/blockMeshDict b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/blockMeshDict
new file mode 100644
index 00000000000..bccda42cfdb
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/blockMeshDict
@@ -0,0 +1,133 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+scale 0.333333333333333;
+
+vertices
+(
+ (-1 0 0.3)
+ (0 0 0.3)
+ (6 0 0.3)
+ (6 3 0.3)
+ (0 3 0.3)
+ (-1 3 0.3)
+
+ (-1 0 0)
+ (0 0 0)
+ (6 0 0)
+ (6 3 0)
+ (0 3 0)
+ (-1 3 0)
+);
+
+blocks
+(
+// //5 patch bottomWall y+ : min = 0.045097146, max = 0.13949865, average = 0.052922426
+ hex (6 7 10 11 0 1 4 5) ( 96 385 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 950 1)
+ hex (7 8 9 10 1 2 3 4) (449 385 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 950 1)
+
+// 3
+// hex (6 7 10 11 0 1 4 5) ( 24 97 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 950 1)
+// hex (7 8 9 10 1 2 3 4) (113 97 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 950 1)
+
+//-------------------------------------------------------------------
+//
+// // 1 min = 0.60914299, max = 1.0197701, average = 0.71020364
+// hex (6 7 10 11 0 1 4 5) (6 25 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 50000 1)
+// hex (7 8 9 10 1 2 3 4) (29 25 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 50000 1)
+//
+// // 2
+// hex (6 7 10 11 0 1 4 5) (12 49 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 50000 1)
+// hex (7 8 9 10 1 2 3 4) (57 49 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 50000 1)
+//
+// // 3 patch bottomWall y+ : min = 0.18489745, max = 0.38018561, average = 0.21587743
+// hex (6 7 10 11 0 1 4 5) ( 24 97 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 50000 1)
+// hex (7 8 9 10 1 2 3 4) (113 97 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 50000 1)
+//
+// // 4
+// hex (6 7 10 11 0 1 4 5) ( 48 193 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 50000 1)
+// hex (7 8 9 10 1 2 3 4) (225 193 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 50000 1)
+
+// //5 patch bottomWall y+ : min = 0.045097146, max = 0.13949865, average = 0.052922426
+// hex (6 7 10 11 0 1 4 5) ( 96 385 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 50000 1)
+// hex (7 8 9 10 1 2 3 4) (449 385 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 50000 1)
+);
+
+edges
+(
+);
+
+boundary
+(
+ inlet
+ {
+ type patch;
+ faces
+ (
+ (6 0 5 11)
+ );
+ }
+ outlet
+ {
+ type patch;
+ faces
+ (
+ (8 9 3 2)
+ );
+ }
+ topWall
+ {
+ type wall;
+ faces
+ (
+ (11 5 4 10)
+ (10 4 3 9)
+ );
+ }
+ bottomWall
+ {
+ type wall;
+ faces
+ (
+ (7 8 2 1)
+ );
+ }
+ symmetry
+ {
+ type symmetryPlane;
+ faces
+ (
+ (6 7 1 0)
+ );
+ }
+ frontAndBack
+ {
+ type empty;
+ faces
+ (
+ (0 1 4 5)
+ (1 2 3 4)
+ (6 11 10 7)
+ (7 10 9 8)
+ );
+ }
+);
+
+mergePatchPairs
+(
+);
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/blockMeshDict.template b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/blockMeshDict.template
new file mode 100644
index 00000000000..de443042acc
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/blockMeshDict.template
@@ -0,0 +1,133 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+scale 0.333333333333333;
+
+vertices
+(
+ (-1 0 0.3)
+ (0 0 0.3)
+ (6 0 0.3)
+ (6 3 0.3)
+ (0 3 0.3)
+ (-1 3 0.3)
+
+ (-1 0 0)
+ (0 0 0)
+ (6 0 0)
+ (6 3 0)
+ (0 3 0)
+ (-1 3 0)
+);
+
+blocks
+(
+// //5 patch bottomWall y+ : min = 0.045097146, max = 0.13949865, average = 0.052922426
+ hex (6 7 10 11 0 1 4 5) ( 96 385 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) GRADING 1)
+ hex (7 8 9 10 1 2 3 4) (449 385 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) GRADING 1)
+
+// 3
+// hex (6 7 10 11 0 1 4 5) ( 24 97 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) GRADING 1)
+// hex (7 8 9 10 1 2 3 4) (113 97 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) GRADING 1)
+
+//-------------------------------------------------------------------
+//
+// // 1 min = 0.60914299, max = 1.0197701, average = 0.71020364
+// hex (6 7 10 11 0 1 4 5) (6 25 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 50000 1)
+// hex (7 8 9 10 1 2 3 4) (29 25 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 50000 1)
+//
+// // 2
+// hex (6 7 10 11 0 1 4 5) (12 49 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 50000 1)
+// hex (7 8 9 10 1 2 3 4) (57 49 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 50000 1)
+//
+// // 3 patch bottomWall y+ : min = 0.18489745, max = 0.38018561, average = 0.21587743
+// hex (6 7 10 11 0 1 4 5) ( 24 97 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 50000 1)
+// hex (7 8 9 10 1 2 3 4) (113 97 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 50000 1)
+//
+// // 4
+// hex (6 7 10 11 0 1 4 5) ( 48 193 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 50000 1)
+// hex (7 8 9 10 1 2 3 4) (225 193 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 50000 1)
+
+// //5 patch bottomWall y+ : min = 0.045097146, max = 0.13949865, average = 0.052922426
+// hex (6 7 10 11 0 1 4 5) ( 96 385 1) simpleGrading (((1 9 0.15)(0.1 3 0.9)) 50000 1)
+// hex (7 8 9 10 1 2 3 4) (449 385 1) simpleGrading (((0.1 22 1.5)(0.35 23 7)(0.515 12 1)) 50000 1)
+);
+
+edges
+(
+);
+
+boundary
+(
+ inlet
+ {
+ type patch;
+ faces
+ (
+ (6 0 5 11)
+ );
+ }
+ outlet
+ {
+ type patch;
+ faces
+ (
+ (8 9 3 2)
+ );
+ }
+ topWall
+ {
+ type wall;
+ faces
+ (
+ (11 5 4 10)
+ (10 4 3 9)
+ );
+ }
+ bottomWall
+ {
+ type wall;
+ faces
+ (
+ (7 8 2 1)
+ );
+ }
+ symmetry
+ {
+ type symmetryPlane;
+ faces
+ (
+ (6 7 1 0)
+ );
+ }
+ frontAndBack
+ {
+ type empty;
+ faces
+ (
+ (0 1 4 5)
+ (1 2 3 4)
+ (6 11 10 7)
+ (7 10 9 8)
+ );
+ }
+);
+
+mergePatchPairs
+(
+);
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/controlDict b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/controlDict
new file mode 100644
index 00000000000..8aa23db77a4
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/controlDict
@@ -0,0 +1,68 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object controlDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+application simpleFoam;
+
+startFrom startTime;
+
+startTime 0;
+
+stopAt endTime;
+
+endTime 5000;
+
+deltaT 1;
+
+writeControl timeStep;
+
+writeInterval 100;
+
+purgeWrite 1;
+
+writeFormat ascii;
+
+writePrecision 8;
+
+writeCompression off;
+
+timeFormat general;
+
+timePrecision 8;
+
+runTimeModifiable true;
+
+functions
+{
+ minMax
+ {
+ type fieldMinMax;
+ libs ("libfieldFunctionObjects.so");
+ writeControl timeStep; //writeTime;
+ fields (U);
+ }
+ yPlus
+ {
+ type yPlus;
+ libs ("libfieldFunctionObjects.so");
+ patches (fixedWall);
+ writeControl writeTime;
+ }
+ #includeFunc "writeCellCentres"
+ #includeFunc "wallShearStress"
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/decomposeParDict b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/decomposeParDict
new file mode 100644
index 00000000000..152544e2724
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/decomposeParDict
@@ -0,0 +1,51 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+
+FoamFile
+{
+ version 2.3;
+ format ascii;
+ class dictionary;
+ object decomposeParDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+
+numberOfSubdomains 8 ;
+method hierarchical ;
+simpleCoeffs
+{
+ n (8 1 1);
+ delta 0.001;
+}
+hierarchicalCoeffs
+{
+ n (8 1 1);
+ delta 0.001;
+ order xyz;
+}
+scotchCoeffs
+{
+ processorWeights
+ (
+ 1
+ 1
+ 1
+ 1
+ 1
+ 1
+ 1
+ 1
+ );
+}
+manualCoeffs
+{
+ dataFile ("" );
+}
+distributed no ;
+roots ();
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/fvSchemes b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/fvSchemes
new file mode 100644
index 00000000000..1d97d6c0f85
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/fvSchemes
@@ -0,0 +1,60 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+ default steadyState;
+}
+
+gradSchemes
+{
+ default Gauss linear;
+}
+
+divSchemes
+{
+ default none;
+ div(phi,U) bounded Gauss linearUpwind grad(U);
+ div(phi,k) bounded Gauss limitedLinear 1;
+ div(phi,epsilon) bounded Gauss limitedLinear 1;
+ div(phi,omega) bounded Gauss limitedLinear 1;
+ div((nuEff*dev2(T(grad(U))))) Gauss linear;
+}
+
+laplacianSchemes
+{
+ default Gauss linear uncorrected;
+ laplacian(DomegaEff,omega) Gauss linear uncorrected;
+}
+
+interpolationSchemes
+{
+ default linear;
+}
+
+snGradSchemes
+{
+ default uncorrected;
+}
+
+wallDist
+{
+ method meshWave;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/fvSolution b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/fvSolution
new file mode 100644
index 00000000000..bce8d118470
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/turbulentFlatPlate/system/fvSolution
@@ -0,0 +1,84 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: plus |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+ p
+ {
+ solver GAMG;
+ tolerance 1e-10;
+ relTol 0.1;
+ smoother DICGaussSeidel;
+ nPreSweeps 0;
+ nPostSweeps 2;
+ cacheAgglomeration on;
+ agglomerator faceAreaPair;
+ nCellsInCoarsestLevel 10;
+ mergeLevels 1;
+ }
+
+ "(U|k|epsilon|R|nuTilda)"
+ {
+ solver smoothSolver;
+ smoother symGaussSeidel;
+ tolerance 1e-10;
+ relTol 0.1;
+ }
+ omega
+ {
+ solver PBiCGStab;
+ preconditioner DILU;
+ tolerance 1e-10;
+ relTol 0.1;
+ }
+}
+
+SIMPLE
+{
+ nNonOrthogonalCorrectors 0;
+
+/*
+ residualControl
+ {
+ p 1e-6;
+ U 1e-6;
+ "(k|epsilon|omega)" 1e-6;
+ }
+*/
+
+ consistent yes;
+}
+
+relaxationFactors
+{
+ equations
+ {
+ U 0.9;
+ k 0.8;
+ epsilon 0.7;
+ nuTilda 0.8;
+ omega 0.8;
+ }
+}
+
+
+cache
+{
+ grad(U);
+}
+
+// ************************************************************************* //
--
GitLab