From 79f9c3bb7dbdea70e6dd84b30344adbec7604fdc Mon Sep 17 00:00:00 2001
From: Andrew Heather <>
Date: Tue, 18 Dec 2018 19:08:03 +0000
Subject: [PATCH] TUT: Added new bump2D case
---
.../incompressible/simpleFoam/bump2D/0/U | 57 ++++++
.../simpleFoam/bump2D/0/nuTilda | 59 ++++++
.../incompressible/simpleFoam/bump2D/0/nut | 58 ++++++
.../incompressible/simpleFoam/bump2D/0/omega | 60 ++++++
.../incompressible/simpleFoam/bump2D/0/p | 56 +++++
.../incompressible/simpleFoam/bump2D/Allrun | 9 +
.../bump2D/constant/transportProperties | 22 ++
.../bump2D/constant/turbulenceProperties | 31 +++
.../simpleFoam/bump2D/createPlots | 104 ++++++++++
.../simpleFoam/bump2D/system/blockMeshDict | 191 ++++++++++++++++++
.../simpleFoam/bump2D/system/controlDict | 113 +++++++++++
.../simpleFoam/bump2D/system/decomposeParDict | 28 +++
.../simpleFoam/bump2D/system/fvSchemes | 60 ++++++
.../simpleFoam/bump2D/system/fvSolution | 64 ++++++
14 files changed, 912 insertions(+)
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/0/U
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/0/nuTilda
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/0/nut
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/0/omega
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/0/p
create mode 100755 tutorials/incompressible/simpleFoam/bump2D/Allrun
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/constant/transportProperties
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/constant/turbulenceProperties
create mode 100755 tutorials/incompressible/simpleFoam/bump2D/createPlots
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/system/blockMeshDict
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/system/controlDict
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/system/decomposeParDict
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/system/fvSchemes
create mode 100644 tutorials/incompressible/simpleFoam/bump2D/system/fvSolution
diff --git a/tutorials/incompressible/simpleFoam/bump2D/0/U b/tutorials/incompressible/simpleFoam/bump2D/0/U
new file mode 100644
index 00000000000..a6414f374f0
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/0/U
@@ -0,0 +1,57 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volVectorField;
+ object U;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -1 0 0 0 0];
+
+internalField uniform (69.44 0 0);
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type inletOutlet;
+ inletValue uniform (0 0 0);
+ value $internalField;
+ }
+
+ top
+ {
+ type symmetryPlane;
+ }
+
+ "(symUp|symDown)"
+ {
+ type symmetryPlane;
+ }
+
+ bump
+ {
+ type noSlip;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/bump2D/0/nuTilda b/tutorials/incompressible/simpleFoam/bump2D/0/nuTilda
new file mode 100644
index 00000000000..9385c4901a3
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/0/nuTilda
@@ -0,0 +1,59 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object nuTilda;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 6.93e-5; // 3*nu_inf
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type inletOutlet;
+ inletValue $internalField;
+ value $internalField;
+ }
+
+ top
+ {
+ type symmetryPlane;
+ }
+
+ "(symUp|symDown)"
+ {
+ type symmetryPlane;
+ }
+
+ bump
+ {
+ type fixedValue;
+ value uniform 0;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/bump2D/0/nut b/tutorials/incompressible/simpleFoam/bump2D/0/nut
new file mode 100644
index 00000000000..1216ad6c46a
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/0/nut
@@ -0,0 +1,58 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object nut;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 4.86e-6;
+
+boundaryField
+{
+ inlet
+ {
+ type calculated;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type calculated;
+ value $internalField;
+ }
+
+ top
+ {
+ type symmetryPlane;
+ }
+
+ "(symUp|symDown)"
+ {
+ type symmetryPlane;
+ }
+
+ bump
+ {
+ type fixedValue;
+ value uniform 0;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/bump2D/0/omega b/tutorials/incompressible/simpleFoam/bump2D/0/omega
new file mode 100644
index 00000000000..951fb007417
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/0/omega
@@ -0,0 +1,60 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object omega;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [ 0 0 -1 0 0 0 0 ];
+
+internalField uniform 5220.8;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+
+ outlet
+ {
+ type inletOutlet;
+ inletValue $internalField;
+ value $internalField;
+ }
+
+ top
+ {
+ type symmetryPlane;
+ }
+
+ "(symUp|symDown)"
+ {
+ type symmetryPlane;
+ }
+
+ bump
+ {
+ type omegaWallFunction;
+ value $internalField;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/bump2D/0/p b/tutorials/incompressible/simpleFoam/bump2D/0/p
new file mode 100644
index 00000000000..f7be992968e
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/0/p
@@ -0,0 +1,56 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ inlet
+ {
+ type zeroGradient;
+ }
+
+ outlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+
+ top
+ {
+ type symmetryPlane;
+ }
+
+ "(symUp|symDown)"
+ {
+ type symmetryPlane;
+ }
+
+ bump
+ {
+ type zeroGradient;
+ }
+
+ frontAndBack
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/bump2D/Allrun b/tutorials/incompressible/simpleFoam/bump2D/Allrun
new file mode 100755
index 00000000000..61f1172ce8e
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/Allrun
@@ -0,0 +1,9 @@
+#!/bin/sh
+cd ${0%/*} || exit 1 # Run from this directory
+. $WM_PROJECT_DIR/bin/tools/RunFunctions # Tutorial run functions
+
+runApplication blockMesh
+runApplication $(getApplication)
+
+
+#------------------------------------------------------------------------------
diff --git a/tutorials/incompressible/simpleFoam/bump2D/constant/transportProperties b/tutorials/incompressible/simpleFoam/bump2D/constant/transportProperties
new file mode 100644
index 00000000000..d7e52ee1f77
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/constant/transportProperties
@@ -0,0 +1,22 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object transportProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+transportModel Newtonian;
+
+nu 2.31e-5;
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/bump2D/constant/turbulenceProperties b/tutorials/incompressible/simpleFoam/bump2D/constant/turbulenceProperties
new file mode 100644
index 00000000000..2bf170f3e2d
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/constant/turbulenceProperties
@@ -0,0 +1,31 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object turbulenceProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType RAS;
+
+RAS
+{
+// RASModel kOmegaSST;
+ RASModel SpalartAllmaras;
+
+ turbulence on;
+
+ printCoeffs on;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/bump2D/createPlots b/tutorials/incompressible/simpleFoam/bump2D/createPlots
new file mode 100755
index 00000000000..9ae5e39bb52
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/createPlots
@@ -0,0 +1,104 @@
+#!/bin/sh
+# Note: CFL3D data available from:
+# https://turbmodels.larc.nasa.gov/bump_sa.html
+cd ${0%/*} || exit 1 # run from this directory
+
+. $WM_PROJECT_DIR/bin/tools/RunFunctions # Tutorial run functions
+
+#set -x
+
+plotTau() {
+ graphNameTau="hill2D_tau.png"
+ echo "Creating wallshear stress graph to $graphNameTau"
+ gnuplot<<PLT_TAU
+ set terminal pngcairo font "helvetica,20" size 1000, 1000
+ set xrange [0:1.5]
+ set yrange [0:0.008]
+ set grid
+ set key bottom right
+ set xlabel "x"
+ set ylabel "c_f"
+ set output "$graphNameTau"
+
+ Uref = 69.44
+
+ set lmargin 10
+ set rmargin 1.5
+ set bmargin 3.2
+
+# plot \
+# "profiles.dat" u 1:(sqrt(\$2*\$2+\$3*\$3+\$4*\$4)/(0.5*Uref*Uref)) \
+# t "simpleFoam" w l lw 2 lc rgb "black", \
+# "cf_bump_cfl3d_sa.dat" every 10 u 1:2 \
+# t "CFL3D" w p ps 3 pt 6 lw 2 lc rgb "red"
+
+ plot \
+ "profiles.dat" u 1:(sqrt(\$2*\$2+\$3*\$3+\$4*\$4)/(0.5*Uref*Uref)) \
+ t "simpleFoam" w l lw 2 lc rgb "black"
+PLT_TAU
+}
+
+plotCp() {
+ graphNameCp="hill2D_cp.png"
+ echo "Creating pressure coefficient graph to $graphNameCp"
+ gnuplot<<PLT_CP
+ set terminal pngcairo font "helvetica,20" size 1000, 1000
+ set xrange [0:1.5]
+ set yrange [0.4:-0.8]
+ set grid
+ set key bottom right
+ set xlabel "x"
+ set ylabel "c_p"
+ set output "$graphNameCp"
+
+ Uref = 69.44
+
+ set lmargin 10
+ set rmargin 1.5
+ set bmargin 3.2
+
+# plot \
+# "profiles.dat" u 1:5 \
+# t "simpleFoam" w l lw 2 lc rgb "black", \
+# "cp_bump_cfl3d_sa.dat" every 10 u 1:2 \
+# t "CFL3D" w p ps 3 pt 6 lw 2 lc rgb "red"
+
+ plot \
+ "profiles.dat" u 1:5 \
+ t "simpleFoam" w l lw 2 lc rgb "black"
+PLT_CP
+}
+
+
+if notTest $@
+then
+ # Create validation plots
+
+ # Test if gnuplot exists on the system
+ command -v gnuplot >/dev/null 2>&1 || {
+ echo "gnuplot not found - skipping graph creation" 1>&2
+ exit 1
+ }
+
+ # Test if awk exists on the system
+ command -v awk >/dev/null 2>&1 || {
+ echo "awk not found - skipping graph creation" 1>&2
+ exit 1
+ }
+
+ timeDir=$(foamListTimes -latestTime)
+
+ echo "# ccx tau_xx tau_yy tau_zz cp" > profiles.dat
+ foamDictionary -entry boundaryField.bump.value -value $timeDir/Cx | \
+ sed -n '/(/,/)/p' | sed -e 's/[()]//g;/^\s*$/d' > Cx.$$
+ foamDictionary -entry boundaryField.bump.value -value $timeDir/wallShearStress | \
+ sed -n '/(/,/)/p' | sed -e 's/[()]//g;/^\s*$/d' > tau.$$
+ foamDictionary -entry boundaryField.bump.value -value $timeDir/Cp | \
+ sed -n '/(/,/)/p' | sed -e 's/[()]//g;/^\s*$/d' > cp.$$
+ paste -d ' ' Cx.$$ tau.$$ cp.$$ >> profiles.dat
+
+ plotTau
+ plotCp
+
+ \rm -f Cx.$$ tau.$$ cp.$$ profiles.dat
+fi
diff --git a/tutorials/incompressible/simpleFoam/bump2D/system/blockMeshDict b/tutorials/incompressible/simpleFoam/bump2D/system/blockMeshDict
new file mode 100644
index 00000000000..cd630e1e3a4
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/system/blockMeshDict
@@ -0,0 +1,191 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+scale 1;
+
+vertices
+(
+ ( -25.0 0 1 ) // 0
+ ( 0 0 1 ) // 1
+ ( 0.3 0 1 ) // 2
+ ( 1.2 0 1 ) // 3
+ ( 1.5 0 1 ) // 4
+ ( 26.5 0 1 ) // 5
+
+ ( 26.5 5 1 ) // 6
+ ( 1.5 5 1 ) // 7
+ ( 1.2 5 1 ) // 8
+ ( 0.3 5 1 ) // 9
+ ( 0 5 1 ) // 10
+ ( -25.0 5 1 ) // 11
+
+ ( -25.0 0 -1 ) // 12
+ ( 0 0 -1 ) // 13
+ ( 0.3 0 -1 ) // 14
+ ( 1.2 0 -1 ) // 15
+ ( 1.5 0 -1 ) // 16
+ ( 26.5 0 -1 ) // 17
+
+ ( 26.5 5 -1 ) // 18
+ ( 1.5 5 -1 ) // 19
+ ( 1.2 5 -1 ) // 20
+ ( 0.3 5 -1 ) // 21
+ ( 0 5 -1 ) // 22
+ ( -25.0 5 -1 ) // 23
+);
+
+blocks
+(
+ // Medium level for tutorial
+ hex ( 0 1 13 12 11 10 22 23) (30 1 81) simpleGrading (0.002 1 20000)
+ hex ( 1 2 14 13 10 9 21 22) (25 1 81) simpleGrading (2 1 20000)
+ hex ( 2 3 15 14 9 8 20 21) (60 1 81) simpleGrading (1 1 20000)
+ hex ( 3 4 16 15 8 7 19 20) (25 1 81) simpleGrading (0.5 1 20000)
+ hex ( 4 5 17 16 7 6 18 19) (30 1 81) simpleGrading (500 1 20000)
+
+ // Fine
+ //hex ( 0 1 13 12 11 10 22 23) (240 1 648) simpleGrading (0.002 1 20000)
+ //hex ( 1 2 14 13 10 9 21 22) (200 1 648) simpleGrading (2 1 20000)
+ //hex ( 2 3 15 14 9 8 20 21) (480 1 648) simpleGrading (1 1 20000)
+ //hex ( 3 4 16 15 8 7 19 20) (200 1 648) simpleGrading (0.5 1 20000)
+ //hex ( 4 5 17 16 7 6 18 19) (240 1 648) simpleGrading (500 1 20000)
+);
+
+edges #codeStream
+{
+ codeInclude
+ #{
+ #include "pointField.H"
+ #include "mathematicalConstants.H"
+ #};
+
+ code
+ #{
+ const scalar xMin = 0.3;
+ const scalar xMax = 1.2;
+ const label nPoints = 100;
+ const scalar dx = (xMax - xMin)/scalar(nPoints - 1);
+
+ os << "(" << nl << "spline 2 3" << nl;
+ pointField profile(nPoints);
+ const scalar pi = constant::mathematical::pi;
+
+ for (label i = 0; i < nPoints; ++i)
+ {
+ scalar x = xMin + i*dx;
+ profile[i].x() = x;
+ profile[i].y() = 0.05*pow4(sin(pi*x/0.9 - (pi/3)));
+ profile[i].z() = 1;
+ }
+ os << profile << nl;
+
+ os << "spline 14 15" << nl;
+ profile.replace(2, -1);
+ os << profile << nl;
+
+ os << ");" << nl;
+ #};
+};
+
+
+boundary
+(
+ inlet
+ {
+ type patch;
+ faces
+ (
+ (0 11 23 12)
+ );
+ }
+
+ outlet
+ {
+ type patch;
+ faces
+ (
+ (17 18 6 5)
+ );
+ }
+
+ top
+ {
+ type symmetryPlane;
+ faces
+ (
+ (11 10 22 23)
+ (10 9 21 22)
+ ( 9 8 20 21)
+ ( 8 7 19 20)
+ ( 7 6 18 19)
+ );
+ }
+
+ symUp
+ {
+ type symmetryPlane;
+ faces
+ (
+ ( 0 12 13 1)
+ );
+ }
+
+ bump
+ {
+ type wall;
+ faces
+ (
+ ( 1 13 14 2)
+ ( 2 14 15 3)
+ ( 3 15 16 4)
+ );
+ }
+
+ symDown
+ {
+ type symmetryPlane;
+ faces
+ (
+ ( 4 16 17 5)
+ );
+ }
+
+ frontAndBack
+ {
+ type empty;
+ faces
+ (
+ (12 23 22 13)
+ (13 22 21 14)
+ (14 21 20 15)
+ (15 20 19 16)
+ (16 19 18 17)
+
+ ( 0 11 10 1)
+ ( 1 10 9 2)
+ ( 2 9 8 3)
+ ( 3 8 7 4)
+ ( 4 7 6 5)
+ );
+ }
+
+);
+
+mergePatchPairs
+(
+);
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/bump2D/system/controlDict b/tutorials/incompressible/simpleFoam/bump2D/system/controlDict
new file mode 100644
index 00000000000..e53528c11f9
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/system/controlDict
@@ -0,0 +1,113 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object controlDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+application simpleFoam;
+
+startFrom startTime;
+
+startTime 0;
+
+stopAt endTime;
+
+endTime 10000;
+
+deltaT 1;
+
+writeControl timeStep;
+
+writeInterval 100;
+
+purgeWrite 3;
+
+writeFormat ascii;
+
+writePrecision 8;
+
+writeCompression off;
+
+timeFormat general;
+
+timePrecision 8;
+
+runTimeModifiable true;
+
+functions
+{
+ pressure
+ {
+ type pressure;
+ libs ("libfieldFunctionObjects.so");
+ writeControl writeTime;
+ result Cp;
+ calcTotal no;
+ calcCoeff yes;
+ rho rhoInf;
+ rhoInf 1;
+ U UInf;
+ UInf (69.44 0 0);
+ pInf 0;
+ }
+
+ forceCoeffs
+ {
+ libs ("libforces.so");
+ type forceCoeffs;
+ writeControl writeTime;
+ rho rhoInf;
+ rhoInf 1;
+ liftDir (0 1 0);
+ dragDir (1 0 0);
+ CofR (0.75 0 0); // bump midpoint
+ pitchAxis (0 0 1);
+ magUInf 69.44;
+ lRef 0.9; // length of bump
+ Aref 0.1; // mesh span = 2, bump height = 0.05; 2*0.05=0.1
+ patches (bump);
+ }
+
+ wallShearStress
+ {
+ type wallShearStress;
+ libs ("libfieldFunctionObjects.so");
+ writeControl writeTime;
+ patches (bump);
+ }
+
+ yPlus
+ {
+ type yPlus;
+ libs ("libfieldFunctionObjects.so");
+ writeControl writeTime;
+ patches (bump);
+ }
+
+ cellCentres
+ {
+ type writeCellCentres;
+ libs ("libfieldFunctionObjects.so");
+ writeControl writeTime;
+ }
+
+ residuals
+ {
+ type residuals;
+ libs ("libutilityFunctionObjects.so");
+ fields (".*");
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/bump2D/system/decomposeParDict b/tutorials/incompressible/simpleFoam/bump2D/system/decomposeParDict
new file mode 100644
index 00000000000..268d7687b05
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/system/decomposeParDict
@@ -0,0 +1,28 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ note "mesh decomposition control dictionary";
+ object decomposeParDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+numberOfSubdomains 8;
+
+method hierarchical;
+
+hierarchicalCoeffs
+{
+ n (8 1 1);
+ // delta 0.001; //< default value = 0.001
+ // order xyz; //< default order = xyz
+}
+
diff --git a/tutorials/incompressible/simpleFoam/bump2D/system/fvSchemes b/tutorials/incompressible/simpleFoam/bump2D/system/fvSchemes
new file mode 100644
index 00000000000..f2678678acb
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/system/fvSchemes
@@ -0,0 +1,60 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+ default steadyState;
+}
+
+gradSchemes
+{
+ default Gauss linear;
+}
+
+divSchemes
+{
+ default none;
+ div(phi,U) bounded Gauss linearUpwind grad(U);
+ div(phi,epsilon) bounded Gauss upwind;
+ div(phi,omega) bounded Gauss upwind;
+ div(phi,k) bounded Gauss upwind;
+ div(phi,nuTilda) bounded Gauss upwind;
+ div((nuEff*dev2(T(grad(U))))) Gauss linear;
+}
+
+laplacianSchemes
+{
+ default Gauss linear corrected;
+}
+
+interpolationSchemes
+{
+ default linear;
+}
+
+snGradSchemes
+{
+ default corrected;
+}
+
+wallDist
+{
+ method meshWave;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/incompressible/simpleFoam/bump2D/system/fvSolution b/tutorials/incompressible/simpleFoam/bump2D/system/fvSolution
new file mode 100644
index 00000000000..9cdf5833aa8
--- /dev/null
+++ b/tutorials/incompressible/simpleFoam/bump2D/system/fvSolution
@@ -0,0 +1,64 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v1806 |
+| \\ / A nd | Web: www.OpenFOAM.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+ p
+ {
+ solver GAMG;
+ smoother DICGaussSeidel;
+ tolerance 1e-08;
+ relTol 0.1;
+ }
+
+ "(U|k|epsilon|omega|nuTilda)"
+ {
+ solver PBiCGStab;
+ preconditioner DILU;
+ tolerance 1e-8;
+ relTol 0;
+ }
+}
+
+SIMPLE
+{
+ nNonOrthogonalCorrectors 0;
+ consistent yes;
+ residualControl
+ {
+ p 1e-5;
+ U 1e-5;
+ "(k|epsilon|omega|nuTilda)" 1e-5;
+ }
+}
+
+relaxationFactors
+{
+ equations
+ {
+ U 0.9;
+ "(k|epsilon|omega|nuTilda)" 0.7;
+ }
+}
+
+
+cache
+{
+ grad(U);
+}
+
+// ************************************************************************* //
--
GitLab