diff --git a/applications/solvers/heatTransfer/solidFoam/Make/options b/applications/solvers/heatTransfer/solidFoam/Make/options
index f8e6b9af409dab0394de597cd707a5b8af8e6c2b..764ab34010b495f5f4cb4556c0e15fdd697b0219 100644
--- a/applications/solvers/heatTransfer/solidFoam/Make/options
+++ b/applications/solvers/heatTransfer/solidFoam/Make/options
@@ -2,6 +2,8 @@ EXE_INC = \
-DFULLDEBUG -g -O0 \
-I$(LIB_SRC)/finiteVolume/lnInclude \
-I$(LIB_SRC)/meshTools/lnInclude \
+ -I$(LIB_SRC)/dynamicMesh/lnInclude \
+ -I$(LIB_SRC)/dynamicFvMesh/lnInclude \
-I$(LIB_SRC)/sampling/lnInclude \
-I$(LIB_SRC)/transportModels/compressible/lnInclude \
-I$(LIB_SRC)/thermophysicalModels/basic/lnInclude \
@@ -13,6 +15,9 @@ EXE_LIBS = \
-lfvOptions \
-lmeshTools \
-lsampling \
+ -ldynamicMesh \
+ -ldynamicFvMesh \
+ -ltopoChangerFvMesh \
-lcompressibleTransportModels \
-lfluidThermophysicalModels \
-lradiationModels \
diff --git a/applications/solvers/heatTransfer/solidFoam/hEqn.H b/applications/solvers/heatTransfer/solidFoam/hEqn.H
index 587c1028b24a7304a098d40ef73fd11aef5b37c4..cef7cd77053b1b2bb367461e1f467a788476f780 100644
--- a/applications/solvers/heatTransfer/solidFoam/hEqn.H
+++ b/applications/solvers/heatTransfer/solidFoam/hEqn.H
@@ -11,6 +11,16 @@
fvOptions(rho, h)
);
+ if (mesh.changing())
+ {
+ surfaceScalarField phihMesh
+ (
+ fvc::interpolate(betav*rho*h)*mesh.phi()
+ );
+
+ hEqn -= fvc::div(phihMesh);
+ }
+
hEqn.relax();
fvOptions.constrain(hEqn);
diff --git a/applications/solvers/heatTransfer/solidFoam/solidFoam.C b/applications/solvers/heatTransfer/solidFoam/solidFoam.C
index 771eb1fe647cfa0a3643ad4bfd05af5219f4ee8b..eef9684c06d34121bf1e3cd3f82de41b917f2fef 100644
--- a/applications/solvers/heatTransfer/solidFoam/solidFoam.C
+++ b/applications/solvers/heatTransfer/solidFoam/solidFoam.C
@@ -35,6 +35,7 @@ Description
\*---------------------------------------------------------------------------*/
#include "fvCFD.H"
+#include "dynamicFvMesh.H"
#include "solidThermo.H"
#include "radiationModel.H"
#include "fvOptions.H"
@@ -57,7 +58,7 @@ int main(int argc, char *argv[])
#include "addCheckCaseOptions.H"
#include "setRootCaseLists.H"
#include "createTime.H"
- #include "createMesh.H"
+ #include "createDynamicFvMesh.H"
#include "createFields.H"
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
@@ -92,13 +93,20 @@ int main(int argc, char *argv[])
Info<< "Time = " << runTime.timeName() << nl << endl;
- while (pimple.correctNonOrthogonal())
+ while (pimple.loop())
{
- #include "hEqn.H"
+ if (pimple.firstIter())
+ {
+ mesh.update();
+ }
+
+ while (pimple.correct())
+ {
+ #include "hEqn.H"
+ }
}
runTime.write();
-
runTime.printExecutionTime(Info);
}
}
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/0/T b/tutorials/heatTransfer/solidFoam/movingCone/0/T
new file mode 100644
index 0000000000000000000000000000000000000000..e4326a768ca2f75f4076552843ad40dcf4afd72a
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/0/T
@@ -0,0 +1,60 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object T;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 0 0 1 0 0 0];
+
+internalField uniform 300;
+
+boundaryField
+{
+ movingWall
+ {
+ type zeroGradient;
+ }
+
+ farFieldMoving
+ {
+ type zeroGradient;
+ }
+
+ fixedWall
+ {
+ type zeroGradient;
+ }
+
+ left
+ {
+ type fixedValue;
+ value uniform 600;
+ }
+
+ farField
+ {
+ type zeroGradient;
+ }
+
+ back
+ {
+ type wedge;
+ }
+
+ front
+ {
+ type wedge;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/0/U b/tutorials/heatTransfer/solidFoam/movingCone/0/U
new file mode 100644
index 0000000000000000000000000000000000000000..02e91f36f5f08040282982dfceceeed362914178
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/0/U
@@ -0,0 +1,61 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volVectorField;
+ object U;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -1 0 0 0 0];
+
+internalField uniform (0 0 0);
+
+boundaryField
+{
+ movingWall
+ {
+ type movingWallVelocity;
+ value $internalField;
+ }
+
+ farFieldMoving
+ {
+ type noSlip;
+ }
+
+ fixedWall
+ {
+ type noSlip;
+ }
+
+ left
+ {
+ type pressureInletOutletVelocity;
+ value $internalField;
+ }
+
+ farField
+ {
+ type noSlip;
+ }
+
+ back
+ {
+ type wedge;
+ }
+
+ front
+ {
+ type wedge;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/0/p b/tutorials/heatTransfer/solidFoam/movingCone/0/p
new file mode 100644
index 0000000000000000000000000000000000000000..c55f7b0ce8d217f517ebef13b51533bc9e4bd885
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/0/p
@@ -0,0 +1,60 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -2 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ movingWall
+ {
+ type zeroGradient;
+ }
+
+ farFieldMoving
+ {
+ type zeroGradient;
+ }
+
+ fixedWall
+ {
+ type zeroGradient;
+ }
+
+ left
+ {
+ type totalPressure;
+ p0 $internalField;
+ }
+
+ farField
+ {
+ type zeroGradient;
+ }
+
+ back
+ {
+ type wedge;
+ }
+
+ front
+ {
+ type wedge;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/0/pointMotionUx b/tutorials/heatTransfer/solidFoam/movingCone/0/pointMotionUx
new file mode 100644
index 0000000000000000000000000000000000000000..65f94262a9238e3cee0bd8c1c352edff528fe756
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/0/pointMotionUx
@@ -0,0 +1,56 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class pointScalarField;
+ object pointMotionUx;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -1 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ movingWall
+ {
+ type uniformFixedValue;
+ uniformValue constant 1;
+ }
+ farFieldMoving
+ {
+ type slip;
+ }
+ fixedWall
+ {
+ type uniformFixedValue;
+ uniformValue constant 0;
+ }
+ left
+ {
+ type uniformFixedValue;
+ uniformValue constant 0;
+ }
+ farField
+ {
+ type slip;
+ }
+ back
+ {
+ type wedge;
+ }
+ front
+ {
+ type wedge;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/constant/dynamicMeshDict b/tutorials/heatTransfer/solidFoam/movingCone/constant/dynamicMeshDict
new file mode 100644
index 0000000000000000000000000000000000000000..fa6594af406762bb3a0d68823afd2eb44e799376
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/constant/dynamicMeshDict
@@ -0,0 +1,28 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object dynamicMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dynamicFvMesh dynamicMotionSolverFvMesh;
+
+motionSolverLibs (fvMotionSolvers);
+
+motionSolver velocityComponentLaplacian;
+
+component x;
+diffusivity directional (1 200 0);
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/constant/radiationProperties b/tutorials/heatTransfer/solidFoam/movingCone/constant/radiationProperties
new file mode 100644
index 0000000000000000000000000000000000000000..f806a0b830d59689a4136db94539d4ef1e39f501
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/constant/radiationProperties
@@ -0,0 +1,24 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object radiationProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+radiation off;
+
+radiationModel none;
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/constant/thermophysicalProperties b/tutorials/heatTransfer/solidFoam/movingCone/constant/thermophysicalProperties
new file mode 100644
index 0000000000000000000000000000000000000000..3422aa87a90c7320d53ca9f311c519f6e3a7dec0
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/constant/thermophysicalProperties
@@ -0,0 +1,52 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object thermophysicalProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+thermoType
+{
+ type heSolidThermo;
+ mixture pureMixture;
+ transport constIso;
+ thermo hConst;
+ equationOfState rhoConst;
+ specie specie;
+ energy sensibleEnthalpy;
+}
+
+mixture
+{
+ specie
+ {
+ molWeight 12;
+ }
+
+ transport
+ {
+ kappa 80;
+ }
+
+ thermodynamics
+ {
+ Hf 0;
+ Cp 450;
+ }
+
+ equationOfState
+ {
+ rho 8000;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/system/blockMeshDict b/tutorials/heatTransfer/solidFoam/movingCone/system/blockMeshDict
new file mode 100644
index 0000000000000000000000000000000000000000..13f50e8765aeead4db65522e70ba4db07f874612
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/system/blockMeshDict
@@ -0,0 +1,144 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+scale 0.001;
+
+mergeType points; // Wedge geometry - Merge points instead of topology
+
+vertices
+(
+ (-7.5 0 0)
+ (-7 0 0)
+ (-3.5 0 0)
+ (0 0 0)
+ (-7.5 0.75 -0.032745707)
+ (-7 0.75 -0.032745707)
+ (-3.5 2 -0.087321886)
+ (0 2 -0.087321886)
+ (-7.5 2.5 -0.10915236)
+ (-7 2.5 -0.10915236)
+ (-3.5 2.5 -0.10915236)
+ (0 2.5 -0.10915236)
+ (-7.5 0.75 0.032745707)
+ (-7 0.75 0.032745707)
+ (-3.5 2 0.087321886)
+ (0 2 0.087321886)
+ (-7.5 2.5 0.10915236)
+ (-7 2.5 0.10915236)
+ (-3.5 2.5 0.10915236)
+ (0 2.5 0.10915236)
+);
+
+blocks
+(
+ hex (0 1 5 4 0 1 13 12) (15 15 1) simpleGrading (1 1 1)
+ hex (2 3 7 6 2 3 15 14) (20 20 1) simpleGrading (2 0.25 1)
+ hex (4 5 9 8 12 13 17 16) (15 15 1) simpleGrading (1 1 1)
+ hex (5 6 10 9 13 14 18 17) (50 15 1) simpleGrading (1 1 1)
+ hex (6 7 11 10 14 15 19 18) (20 15 1) simpleGrading (2 1 1)
+);
+
+edges
+(
+);
+
+boundary
+(
+ movingWall
+ {
+ type wall;
+ faces
+ (
+ (1 5 13 1)
+ (5 6 14 13)
+ (2 2 14 6)
+ );
+ }
+ farFieldMoving
+ {
+ type patch;
+ faces
+ (
+ (9 17 18 10)
+ );
+ }
+ fixedWall
+ {
+ type wall;
+ faces
+ (
+ (3 7 15 3)
+ (7 11 19 15)
+ );
+ }
+ axis
+ {
+ type empty;
+ faces
+ (
+ (0 1 1 0)
+ (2 3 3 2)
+ );
+ }
+ left
+ {
+ type patch;
+ faces
+ (
+ (0 0 12 4)
+ (4 12 16 8)
+ );
+ }
+ farField
+ {
+ type patch;
+ faces
+ (
+ (8 16 17 9)
+ (10 18 19 11)
+ );
+ }
+ back
+ {
+ type wedge;
+ faces
+ (
+ (0 4 5 1)
+ (2 6 7 3)
+ (4 8 9 5)
+ (5 9 10 6)
+ (6 10 11 7)
+ );
+ }
+ front
+ {
+ type wedge;
+ faces
+ (
+ (0 1 13 12)
+ (2 3 15 14)
+ (12 13 17 16)
+ (13 14 18 17)
+ (14 15 19 18)
+ );
+ }
+);
+
+mergePatchPairs
+(
+);
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/system/controlDict b/tutorials/heatTransfer/solidFoam/movingCone/system/controlDict
new file mode 100644
index 0000000000000000000000000000000000000000..b86da47613202aa35f3f8e323f1694203c8677cb
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/system/controlDict
@@ -0,0 +1,56 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object controlDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+application solidFoam;
+
+startFrom startTime;
+
+startTime 0;
+
+stopAt endTime;
+
+endTime 0.003;
+
+deltaT 5e-06;
+
+writeControl timeStep;
+
+writeInterval 40;
+
+purgeWrite 0;
+
+writeFormat binary;
+
+writePrecision 6;
+
+writeCompression off;
+
+timeFormat general;
+
+timePrecision 6;
+
+runTimeModifiable true;
+
+adjustTimeStep no;
+
+maxCo 0.2;
+
+functions
+{
+}
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/system/cuttingPlane b/tutorials/heatTransfer/solidFoam/movingCone/system/cuttingPlane
new file mode 100644
index 0000000000000000000000000000000000000000..990a23202fa883cbe35a7775df560395b01597d3
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/system/cuttingPlane
@@ -0,0 +1,38 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+
+cuttingPlane
+{
+ type surfaces;
+ libs (sampling);
+
+ writeControl writeTime;
+
+ surfaceFormat vtk;
+ fields ( p U );
+
+ interpolationScheme cellPoint;
+
+ surfaces
+ {
+ zNormal
+ {
+ type cuttingPlane;
+ planeType pointAndNormal;
+ pointAndNormalDict
+ {
+ point (0 0 0);
+ normal (0 0 1);
+ }
+ interpolate true;
+ }
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/system/fvSchemes b/tutorials/heatTransfer/solidFoam/movingCone/system/fvSchemes
new file mode 100644
index 0000000000000000000000000000000000000000..d3f676d0f99cf52fc5874824eeb65d70a4c5ebfe
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/system/fvSchemes
@@ -0,0 +1,54 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+ default Euler;
+}
+
+gradSchemes
+{
+ default Gauss linear;
+}
+
+divSchemes
+{
+ default none;
+
+ div(phi,U) Gauss linear;
+ div((nuEff*dev2(T(grad(U))))) Gauss linear;
+}
+
+laplacianSchemes
+{
+ default Gauss linear corrected;
+
+ laplacian(diffusivity,cellMotionU) Gauss linear uncorrected;
+}
+
+interpolationSchemes
+{
+ default linear;
+}
+
+snGradSchemes
+{
+ default corrected;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/system/fvSolution b/tutorials/heatTransfer/solidFoam/movingCone/system/fvSolution
new file mode 100644
index 0000000000000000000000000000000000000000..fedc6d6610f0de26fb47883f43b0ad46cd7cca92
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/system/fvSolution
@@ -0,0 +1,62 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: v2006 |
+| \\ / A nd | Website: www.openfoam.com |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+
+ h
+ {
+ solver PCG;
+ preconditioner DIC;
+ tolerance 1e-05;
+ relTol 0.1;
+ }
+
+ hFinal
+ {
+ $h;
+ tolerance 1e-05;
+ relTol 0;
+ }
+
+ cellMotionUx
+ {
+ solver PCG;
+ preconditioner DIC;
+ tolerance 1e-08;
+ relTol 0;
+ }
+}
+
+PIMPLE
+{
+ correctPhi yes;
+ nOuterCorrectors 2;
+ nCorrectors 1;
+ nNonOrthogonalCorrectors 0;
+}
+
+relaxationFactors
+{
+ equations
+ {
+ "h.*" 1;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/heatTransfer/solidFoam/movingCone/system/vtkWrite b/tutorials/heatTransfer/solidFoam/movingCone/system/vtkWrite
new file mode 100644
index 0000000000000000000000000000000000000000..2ed9f30296eb3050245105e1b1f62900215f5cfb
--- /dev/null
+++ b/tutorials/heatTransfer/solidFoam/movingCone/system/vtkWrite
@@ -0,0 +1,17 @@
+// -*- C++ -*-
+// Minimal example of using the vtkWrite function object.
+vtkWrite
+{
+ type vtkWrite;
+ libs (utilityFunctionObjects);
+ writeControl writeTime;
+
+ boundary false;
+
+ // Fields to output (words or regex)
+ fields (U p "(k|epsilon|omega)");
+
+}
+
+
+// ************************************************************************* //