From da2e7bdbbde4902c1c3e394bf065238ade3801f8 Mon Sep 17 00:00:00 2001
From: Henry Weller <http://cfd.direct>
Date: Thu, 20 Aug 2015 15:29:44 +0100
Subject: [PATCH]
tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection: New
tutorial to demonstrate steam condensation
---
.../laminar/steamInjection/0/T.steam | 42 ++++
.../laminar/steamInjection/0/T.water | 42 ++++
.../laminar/steamInjection/0/U.steam | 42 ++++
.../laminar/steamInjection/0/U.water | 42 ++++
.../laminar/steamInjection/0/alpha.steam | 47 ++++
.../laminar/steamInjection/0/alpha.water | 47 ++++
.../laminar/steamInjection/0/nut.water | 41 ++++
.../laminar/steamInjection/0/p | 40 ++++
.../laminar/steamInjection/0/p_rgh | 41 ++++
.../laminar/steamInjection/0/water.steam | 42 ++++
.../laminar/steamInjection/0/water.water | 42 ++++
.../laminar/steamInjection/constant/fvOptions | 81 +++++++
.../laminar/steamInjection/constant/g | 22 ++
.../steamInjection/constant/phaseProperties | 222 ++++++++++++++++++
.../constant/thermophysicalProperties.steam | 60 +++++
.../constant/thermophysicalProperties.water | 66 ++++++
.../constant/turbulenceProperties.steam | 20 ++
.../constant/turbulenceProperties.water | 20 ++
.../steamInjection/system/blockMeshDict | 61 +++++
.../laminar/steamInjection/system/controlDict | 55 +++++
.../laminar/steamInjection/system/fvSchemes | 75 ++++++
.../laminar/steamInjection/system/fvSolution | 97 ++++++++
22 files changed, 1247 insertions(+)
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/T.steam
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/T.water
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/U.steam
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/U.water
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/alpha.steam
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/alpha.water
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/nut.water
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/p
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/p_rgh
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/water.steam
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/water.water
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/fvOptions
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/g
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/phaseProperties
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/thermophysicalProperties.steam
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/thermophysicalProperties.water
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/turbulenceProperties.steam
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/turbulenceProperties.water
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/blockMeshDict
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/controlDict
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/fvSchemes
create mode 100644 tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/fvSolution
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/T.steam b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/T.steam
new file mode 100644
index 00000000000..c0cd064e494
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/T.steam
@@ -0,0 +1,42 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object T.steam;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 0 0 1 0 0 0];
+
+internalField uniform 372.76;
+
+boundaryField
+{
+ walls
+ {
+ type zeroGradient;
+ }
+ outlet
+ {
+ type inletOutlet;
+ phi phi.steam;
+ inletValue $internalField;
+ value $internalField;
+ }
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+}
+
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/T.water b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/T.water
new file mode 100644
index 00000000000..16c68c31f2f
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/T.water
@@ -0,0 +1,42 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object T.water;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 0 0 1 0 0 0];
+
+internalField uniform 360;
+
+boundaryField
+{
+ walls
+ {
+ type fixedValue;
+ value $internalField;
+ }
+ outlet
+ {
+ type inletOutlet;
+ phi phi.water;
+ inletValue $internalField;
+ value $internalField;
+ }
+ inlet
+ {
+ type zeroGradient;
+ }
+}
+
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/U.steam b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/U.steam
new file mode 100644
index 00000000000..15d945857aa
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/U.steam
@@ -0,0 +1,42 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format binary;
+ class volVectorField;
+ location "0";
+ object U.steam;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -1 0 0 0 0];
+
+internalField uniform (0 0.1 0);
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value uniform (0 0.1 0);
+ }
+ outlet
+ {
+ type pressureInletOutletVelocity;
+ phi phi.steam;
+ value $internalField;
+ }
+ walls
+ {
+ type fixedValue;
+ value uniform (0 0 0);
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/U.water b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/U.water
new file mode 100644
index 00000000000..256fe1cb1ad
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/U.water
@@ -0,0 +1,42 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format binary;
+ class volVectorField;
+ location "0";
+ object U.water;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -1 0 0 0 0];
+
+internalField uniform (0 0.1 0);
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value uniform (0 0.1 0);
+ }
+ outlet
+ {
+ type pressureInletOutletVelocity;
+ phi phi.water;
+ value $internalField;
+ }
+ walls
+ {
+ type fixedValue;
+ value uniform (0 0 0);
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/alpha.steam b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/alpha.steam
new file mode 100644
index 00000000000..0b69e50eed9
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/alpha.steam
@@ -0,0 +1,47 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object alpha.steam;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 0 0 0 0 0 0];
+
+internalField uniform 0;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value uniform 0.;
+ }
+ outlet
+ {
+ type inletOutlet;
+ phi phi.steam;
+ inletValue uniform 0;
+ value uniform 0;
+ }
+ walls
+ {
+ type zeroGradient;
+ }
+ defaultFaces
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/alpha.water b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/alpha.water
new file mode 100644
index 00000000000..f7aab53be20
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/alpha.water
@@ -0,0 +1,47 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object alpha.water;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 0 0 0 0 0 0];
+
+internalField uniform 1;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value uniform 1.;
+ }
+ outlet
+ {
+ type inletOutlet;
+ phi phi.water;
+ inletValue uniform 1.0;
+ value uniform 1.0;
+ }
+ walls
+ {
+ type zeroGradient;
+ }
+ defaultFaces
+ {
+ type empty;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/nut.water b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/nut.water
new file mode 100644
index 00000000000..634a29a38b5
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/nut.water
@@ -0,0 +1,41 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object nut;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 2 -1 0 0 0 0];
+
+internalField uniform 1e-8;
+
+boundaryField
+{
+ inlet
+ {
+ type calculated;
+ value $internalField;
+ }
+ outlet
+ {
+ type calculated;
+ value $internalField;
+ }
+ walls
+ {
+ type nutkWallFunction;
+ value $internalField;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/p b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/p
new file mode 100644
index 00000000000..799576be27a
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/p
@@ -0,0 +1,40 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object p;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [ 1 -1 -2 0 0 0 0 ];
+
+internalField uniform 1e5;
+
+boundaryField
+{
+ inlet
+ {
+ type calculated;
+ value $internalField;
+ }
+ outlet
+ {
+ type calculated;
+ value $internalField;
+ }
+ walls
+ {
+ type calculated;
+ value $internalField;
+ }
+}
+
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/p_rgh b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/p_rgh
new file mode 100644
index 00000000000..071e58a3951
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/p_rgh
@@ -0,0 +1,41 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ object p_rgh;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [ 1 -1 -2 0 0 0 0 ];
+
+internalField uniform 1e5;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedFluxPressure;
+ value $internalField;
+ }
+ outlet
+ {
+ type prghPressure;
+ p $internalField;
+ value $internalField;
+ }
+ walls
+ {
+ type fixedFluxPressure;
+ value $internalField;
+ }
+}
+
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/water.steam b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/water.steam
new file mode 100644
index 00000000000..edd088bc174
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/water.steam
@@ -0,0 +1,42 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object AIR.steam;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 0 0 0 0 0 0];
+
+internalField uniform 1;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value uniform 1;
+ }
+ outlet
+ {
+ type inletOutlet;
+ phi phi.steam;
+ inletValue $internalField;
+ value $internalField;
+ }
+ walls
+ {
+ type zeroGradient;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/water.water b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/water.water
new file mode 100644
index 00000000000..78063efe664
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/0/water.water
@@ -0,0 +1,42 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class volScalarField;
+ location "0";
+ object AIR.water;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 0 0 0 0 0 0];
+
+internalField uniform 1;
+
+boundaryField
+{
+ inlet
+ {
+ type fixedValue;
+ value $internalField;
+ }
+ outlet
+ {
+ type inletOutlet;
+ phi phi.water;
+ inletValue $internalField;
+ value $internalField;
+ }
+ walls
+ {
+ type zeroGradient;
+ }
+}
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/fvOptions b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/fvOptions
new file mode 100644
index 00000000000..6a3a4da0be7
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/fvOptions
@@ -0,0 +1,81 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object fvOptions;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+injector1
+{
+ timeStart 1;
+ duration 500;
+ selectionMode points;
+ points
+ (
+ (0.075 0.2 0.05)
+ );
+}
+
+options
+{
+ massSource1
+ {
+ type scalarSemiImplicitSource;
+
+ scalarSemiImplicitSourceCoeffs
+ {
+ $injector1;
+
+ volumeMode absolute;
+ injectionRateSuSp
+ {
+ thermo:rho.steam (1.0e-3 0); // kg/s
+ }
+ }
+ }
+
+ momentumSource1
+ {
+ type vectorSemiImplicitSource;
+
+ vectorSemiImplicitSourceCoeffs
+ {
+ $injector1;
+
+ volumeMode absolute;
+ injectionRateSuSp
+ {
+ U.steam ((0 1e-1 0) 0); // kg*m/s^2
+ }
+ }
+ }
+
+ energySource1
+ {
+ type scalarSemiImplicitSource;
+
+ scalarSemiImplicitSourceCoeffs
+ {
+ $injector1;
+
+ volumeMode absolute;
+ injectionRateSuSp
+ {
+ e.steam (3700 0); // kg*m^2/s^3
+ }
+ }
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/g b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/g
new file mode 100644
index 00000000000..0cc222ca345
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/g
@@ -0,0 +1,22 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class uniformDimensionedVectorField;
+ location "constant";
+ object g;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+dimensions [0 1 -2 0 0 0 0];
+value (0 -9.81 0);
+
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/phaseProperties b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/phaseProperties
new file mode 100644
index 00000000000..fc976bc67cb
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/phaseProperties
@@ -0,0 +1,222 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object phaseProperties;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+type thermalPhaseChangeTwoPhaseSystem;
+
+phases (steam water);
+
+volatile "water";
+
+massTransfer on;
+
+steam
+{
+ type multiComponentPhaseModel;
+ diameterModel isothermal;
+ isothermalCoeffs
+ {
+ d0 3e-3;
+ p0 1e5;
+ }
+ Sc 0.7;
+
+ residualAlpha 1e-6;
+}
+
+water
+{
+ type multiComponentPhaseModel;
+ diameterModel constant;
+ constantCoeffs
+ {
+ d 1e-4;
+ }
+ Sc 0.7;
+
+ residualAlpha 1e-6;
+}
+
+blending
+{
+ default
+ {
+ type none;
+ continuousPhase water;
+ minFullyContinuousAlpha.steam 0.7;
+ minPartlyContinuousAlpha.steam 0.5;
+ minFullyContinuousAlpha.water 0.7;
+ minPartlyContinuousAlpha.water 0.5;
+ }
+
+ heatTransfer
+ {
+ type none;
+ continuousPhase water;
+ minFullyContinuousAlpha.steam 1;
+ minPartlyContinuousAlpha.steam 0;
+ minFullyContinuousAlpha.water 1;
+ minPartlyContinuousAlpha.water 0;
+ }
+
+ massTransfer
+ {
+ type none;
+ continuousPhase water;
+ minFullyContinuousAlpha.steam 1;
+ minPartlyContinuousAlpha.steam 0;
+ minFullyContinuousAlpha.water 1;
+ minPartlyContinuousAlpha.water 0;
+ }
+}
+
+surfaceTension
+(
+ (steam and water)
+ {
+ type constant;
+ sigma 0.07;
+ }
+);
+
+saturationModel
+{
+ type constant;
+ pSat 1e5;
+ Tsat 372.76;
+};
+
+
+aspectRatio
+(
+ (steam in water)
+ {
+ type constant;
+ E0 1.0;
+ }
+
+ (water in steam)
+ {
+ type constant;
+ E0 1.0;
+ }
+);
+
+drag
+(
+ (steam in water)
+ {
+ type SchillerNaumann;
+ residualRe 1e-3;
+ swarmCorrection
+ {
+ type none;
+ }
+ }
+
+ (water in steam)
+ {
+ type SchillerNaumann;
+ residualRe 1e-3;
+ swarmCorrection
+ {
+ type none;
+ }
+ }
+);
+
+virtualMass
+(
+ (steam in water)
+ {
+ type constantCoefficient;
+ Cvm 0.5;
+ }
+
+ (water in steam)
+ {
+ type constantCoefficient;
+ Cvm 0.5;
+ }
+);
+
+interfaceComposition
+(
+ (steam in water)
+ {
+ type Saturated;
+ species ( H2O );
+ Le 1.0;
+ saturationPressure
+ {
+ type ArdenBuck;
+ }
+ }
+
+);
+
+heatTransfer.steam
+(
+ (steam in water)
+ {
+ type spherical;
+ residualAlpha 1e-4;
+ }
+);
+
+heatTransfer.water
+(
+ (steam in water)
+ {
+ type RanzMarshall;
+ residualAlpha 1e-4;
+ }
+);
+
+massTransfer.steam
+(
+
+);
+
+massTransfer.water
+(
+
+);
+
+lift
+(
+);
+
+wallLubrication
+(
+);
+
+turbulentDispersion
+(
+ (steam in water)
+ {
+ type Burns;//
+ sigma 0.7;
+ Ctd 1.0;
+ residualAlpha 1e-3;
+ }
+);
+
+// Minimum allowable pressure
+pMin 10000;
+
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/thermophysicalProperties.steam b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/thermophysicalProperties.steam
new file mode 100644
index 00000000000..4053b173ee9
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/thermophysicalProperties.steam
@@ -0,0 +1,60 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object thermophysicalProperties.steam;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+thermoType
+{
+ type heRhoThermo;
+ mixture multiComponentMixture;
+ transport const;
+ thermo hRefConst;
+ equationOfState perfectGas;
+ specie specie;
+ energy sensibleInternalEnergy;
+}
+
+species
+(
+ water
+);
+
+inertSpecie water;
+
+water
+{
+ specie
+ {
+ nMoles 1;
+ molWeight 18.0153;
+ }
+
+ thermodynamics
+ {
+ Hf 0;
+ Cp 2078.4;
+ Tref 372.76;
+ Href 2675500;
+ }
+
+ transport
+ {
+ mu 1.2256e-5;
+ Pr 2.289;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/thermophysicalProperties.water b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/thermophysicalProperties.water
new file mode 100644
index 00000000000..3e40c9dce6a
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/thermophysicalProperties.water
@@ -0,0 +1,66 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object thermophysicalProperties.water;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+thermoType
+{
+ type heRhoThermo;
+ mixture multiComponentMixture;
+ transport const;
+ thermo hRefConst;
+ equationOfState perfectFluid;
+ specie specie;
+ energy sensibleInternalEnergy;
+}
+
+species
+(
+ water
+);
+
+inertSpecie water;
+
+water
+{
+ specie
+ {
+ nMoles 1;
+ molWeight 18.0153;
+ }
+
+ equationOfState
+ {
+ R 3000;
+ rho0 959;
+ }
+
+ thermodynamics
+ {
+ Hf 0;
+ Cp 4195;
+ Tref 372.76;
+ Href 417500;
+ }
+
+ transport
+ {
+ mu 2.8291e-4;
+ Pr 2.289;
+ }
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/turbulenceProperties.steam b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/turbulenceProperties.steam
new file mode 100644
index 00000000000..bdcd006d4eb
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/turbulenceProperties.steam
@@ -0,0 +1,20 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object turbulenceProperties.steam;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType laminar;
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/turbulenceProperties.water b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/turbulenceProperties.water
new file mode 100644
index 00000000000..2accd9147b9
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/constant/turbulenceProperties.water
@@ -0,0 +1,20 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "constant";
+ object turbulenceProperties.water;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+simulationType laminar;
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/blockMeshDict b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/blockMeshDict
new file mode 100644
index 00000000000..d03967afdc2
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/blockMeshDict
@@ -0,0 +1,61 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ object blockMeshDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+convertToMeters 1;
+
+vertices
+(
+ (0 0 0)
+ (0.15 0 0)
+ (0.15 1 0)
+ (0 1 0)
+ (0 0 0.1)
+ (0.15 0 0.1)
+ (0.15 1 0.1)
+ (0 1 0.1)
+);
+
+blocks
+(
+ hex (0 1 2 3 4 5 6 7) (25 75 1) simpleGrading (1 1 1)
+);
+
+edges
+(
+);
+
+patches
+(
+ patch inlet
+ (
+ (1 5 4 0)
+ )
+ patch outlet
+ (
+ (3 7 6 2)
+ )
+ wall walls
+ (
+ (0 4 7 3)
+ (2 6 5 1)
+ )
+);
+
+mergePatchPairs
+(
+);
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/controlDict b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/controlDict
new file mode 100644
index 00000000000..c39421ffae2
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/controlDict
@@ -0,0 +1,55 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object controlDict;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+application reactingTwoPhaseEulerFoam;
+
+startFrom startTime;
+
+startTime 0;
+
+stopAt endTime;
+
+endTime 10;
+
+deltaT 1e-6;
+
+writeControl adjustableRunTime;
+
+writeInterval 0.5;
+
+purgeWrite 0;
+
+writeFormat ascii;
+
+writePrecision 10;
+
+writeCompression compressed;
+
+timeFormat general;
+
+timePrecision 6;
+
+runTimeModifiable yes;
+
+adjustTimeStep yes;
+
+maxCo 0.1;
+
+maxDeltaT 1e-2;
+
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/fvSchemes b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/fvSchemes
new file mode 100644
index 00000000000..2eb1993dc71
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/fvSchemes
@@ -0,0 +1,75 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSchemes;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ddtSchemes
+{
+ default Euler;
+}
+
+gradSchemes
+{
+ default Gauss linear;
+}
+
+divSchemes
+{
+ default none;
+
+ "div\(phi,alpha.*\)" Gauss vanLeer;
+ "div\(phir,alpha.*\)" Gauss vanLeer;
+
+ "div\(alphaRhoPhi.*,U.*\)" Gauss limitedLinearV 1;
+ "div\(phi.*,U.*\)" Gauss limitedLinearV 1;
+
+ "div\(alphaRhoPhi.*,Yi\)" Gauss limitedLinear 1;
+ "div\(alphaRhoPhi.*,(h|e).*\)" Gauss limitedLinear 1;
+ "div\(alphaRhoPhi.*,K.*\)" Gauss limitedLinear 1;
+ "div\(alphaPhi.*,p\)" Gauss limitedLinear 1;
+
+ "div\(alphaRhoPhi.*,(k|epsilon).*\)" Gauss limitedLinear 1;
+ "div\(phim,(k|epsilon)m\)" Gauss limitedLinear 1;
+
+ "div\(\(\(\(alpha.*\*thermo:rho.*\)\*nuEff.*\)\*dev2\(T\(grad\(U.*\)\)\)\)\)" Gauss linear;
+}
+
+laplacianSchemes
+{
+ default Gauss linear uncorrected;
+}
+
+interpolationSchemes
+{
+ default linear;
+}
+
+snGradSchemes
+{
+ default uncorrected;
+}
+
+fluxRequired
+{
+ default no;
+}
+
+wallDist
+{
+ method meshWave;
+}
+
+
+// ************************************************************************* //
diff --git a/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/fvSolution b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/fvSolution
new file mode 100644
index 00000000000..6cf90aa61f3
--- /dev/null
+++ b/tutorials/multiphase/reactingTwoPhaseEulerFoam/laminar/steamInjection/system/fvSolution
@@ -0,0 +1,97 @@
+/*--------------------------------*- C++ -*----------------------------------*\
+| ========= | |
+| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
+| \\ / O peration | Version: dev |
+| \\ / A nd | Web: www.OpenFOAM.org |
+| \\/ M anipulation | |
+\*---------------------------------------------------------------------------*/
+FoamFile
+{
+ version 2.0;
+ format ascii;
+ class dictionary;
+ location "system";
+ object fvSolution;
+}
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+solvers
+{
+ "alpha.*"
+ {
+ nAlphaCorr 1;
+ nAlphaSubCycles 3;
+ }
+
+ p_rgh
+ {
+ solver PCG;
+ preconditioner DIC;
+ tolerance 1e-8;
+ relTol 0;
+ }
+
+ p_rghFinal
+ {
+ $p_rgh;
+ relTol 0;
+ }
+
+ "U.*"
+ {
+ solver smoothSolver;
+ smoother symGaussSeidel;
+ tolerance 1e-6;
+ relTol 0;
+ minIter 1;
+ }
+
+ "(e|h).*"
+ {
+ solver smoothSolver;
+ smoother symGaussSeidel;
+ tolerance 1e-6;
+ relTol 0;
+ minIter 1;
+ maxIter 20;
+ }
+
+ "(k|epsilon|Theta).*"
+ {
+ solver smoothSolver;
+ smoother symGaussSeidel;
+ tolerance 1e-8;
+ relTol 0;
+ minIter 1;
+ }
+
+ Yi
+ {
+ solver smoothSolver;
+ smoother symGaussSeidel;
+ tolerance 1e-6;
+ relTol 0;
+ minIter 1;
+ residualAlpha 1e-8;
+ }
+}
+
+PIMPLE
+{
+ nOuterCorrectors 4;
+ nCorrectors 1;
+ nNonOrthogonalCorrectors 0;
+ nEnergyCorrectors 1;
+ faceMomentum on;
+}
+
+relaxationFactors
+{
+ equations
+ {
+ ".*" 1;
+ }
+}
+
+
+// ************************************************************************* //
--
GitLab