From e1913362ad56722a762d9247dcb580f149016c6d Mon Sep 17 00:00:00 2001
From: andy <andy>
Date: Thu, 31 Jan 2013 15:39:56 +0000
Subject: [PATCH] ENH: Added new thermoFoam utility
---
.../solvers/heatTransfer/thermoFoam/EEqn.H | 34 ++++++
.../heatTransfer/thermoFoam/Make/files | 3 +
.../heatTransfer/thermoFoam/Make/options | 24 ++++
.../heatTransfer/thermoFoam/createFields.H | 54 +++++++++
.../heatTransfer/thermoFoam/setAlphaEff.H | 93 +++++++++++++++
.../heatTransfer/thermoFoam/thermoFoam.C | 107 ++++++++++++++++++
6 files changed, 315 insertions(+)
create mode 100644 applications/solvers/heatTransfer/thermoFoam/EEqn.H
create mode 100644 applications/solvers/heatTransfer/thermoFoam/Make/files
create mode 100644 applications/solvers/heatTransfer/thermoFoam/Make/options
create mode 100644 applications/solvers/heatTransfer/thermoFoam/createFields.H
create mode 100644 applications/solvers/heatTransfer/thermoFoam/setAlphaEff.H
create mode 100644 applications/solvers/heatTransfer/thermoFoam/thermoFoam.C
diff --git a/applications/solvers/heatTransfer/thermoFoam/EEqn.H b/applications/solvers/heatTransfer/thermoFoam/EEqn.H
new file mode 100644
index 00000000000..51232bf0bec
--- /dev/null
+++ b/applications/solvers/heatTransfer/thermoFoam/EEqn.H
@@ -0,0 +1,34 @@
+{
+ volScalarField& he = thermo.he();
+
+ fvScalarMatrix EEqn
+ (
+ fvm::ddt(rho, he) + fvm::div(phi, he)
+ + fvc::ddt(rho, K) + fvc::div(phi, K)
+ + (
+ he.name() == "e"
+ ? fvc::div
+ (
+ fvc::absolute(phi/fvc::interpolate(rho), U),
+ p,
+ "div(phiv,p)"
+ )
+ : -dpdt
+ )
+ - fvm::laplacian(alphaEff, he)
+ ==
+ radiation->Sh(thermo)
+ + fvOptions(rho, he)
+ );
+
+ EEqn.relax();
+
+ fvOptions.constrain(EEqn);
+
+ EEqn.solve();
+
+ fvOptions.correct(he);
+
+ thermo.correct();
+ radiation->correct();
+}
diff --git a/applications/solvers/heatTransfer/thermoFoam/Make/files b/applications/solvers/heatTransfer/thermoFoam/Make/files
new file mode 100644
index 00000000000..825ed0cba8a
--- /dev/null
+++ b/applications/solvers/heatTransfer/thermoFoam/Make/files
@@ -0,0 +1,3 @@
+thermoFoam.C
+
+EXE = $(FOAM_APPBIN)/thermoFoam
diff --git a/applications/solvers/heatTransfer/thermoFoam/Make/options b/applications/solvers/heatTransfer/thermoFoam/Make/options
new file mode 100644
index 00000000000..14bd0d4d24e
--- /dev/null
+++ b/applications/solvers/heatTransfer/thermoFoam/Make/options
@@ -0,0 +1,24 @@
+EXE_INC = \
+ -I$(LIB_SRC)/finiteVolume/lnInclude \
+ -I$(LIB_SRC)/sampling/lnInclude \
+ -I$(LIB_SRC)/meshTools/lnInclude \
+ -I$(LIB_SRC)/fvOptions/lnInclude \
+ -I$(LIB_SRC)/thermophysicalModels/basic/lnInclude \
+ -I$(LIB_SRC)/thermophysicalModels/radiationModels/lnInclude \
+ -I$(LIB_SRC)/turbulenceModels \
+ -I$(LIB_SRC)/turbulenceModels/compressible/turbulenceModel/lnInclude \
+ -I$(LIB_SRC)/turbulenceModels/compressible/RAS/lnInclude \
+ -I$(LIB_SRC)/turbulenceModels/compressible/LES/lnInclude \
+ -I$(LIB_SRC)/turbulenceModels/LES/LESdeltas/lnInclude
+
+EXE_LIBS = \
+ -lfiniteVolume \
+ -lsampling \
+ -lmeshTools \
+ -lfvOptions \
+ -lfluidThermophysicalModels \
+ -lradiationModels \
+ -lspecie \
+ -lcompressibleTurbulenceModel \
+ -lcompressibleRASModels \
+ -lcompressibleLESModels
diff --git a/applications/solvers/heatTransfer/thermoFoam/createFields.H b/applications/solvers/heatTransfer/thermoFoam/createFields.H
new file mode 100644
index 00000000000..ffa6c3f3b52
--- /dev/null
+++ b/applications/solvers/heatTransfer/thermoFoam/createFields.H
@@ -0,0 +1,54 @@
+ Info<< "Reading thermophysical properties\n" << endl;
+
+ autoPtr<rhoThermo> pThermo(rhoThermo::New(mesh));
+ rhoThermo& thermo = pThermo();
+ thermo.validate(args.executable(), "h", "e");
+
+ volScalarField rho
+ (
+ IOobject
+ (
+ "rho",
+ runTime.timeName(),
+ mesh,
+ IOobject::NO_READ,
+ IOobject::NO_WRITE
+ ),
+ thermo.rho()
+ );
+
+ volScalarField& p = thermo.p();
+
+ Info<< "Reading field U\n" << endl;
+ volVectorField U
+ (
+ IOobject
+ (
+ "U",
+ runTime.timeName(),
+ mesh,
+ IOobject::MUST_READ,
+ IOobject::AUTO_WRITE
+ ),
+ mesh
+ );
+
+ #include "compressibleCreatePhi.H"
+
+ #include "setAlphaEff.H"
+
+ Info<< "Creating field dpdt\n" << endl;
+ volScalarField dpdt
+ (
+ IOobject
+ (
+ "dpdt",
+ runTime.timeName(),
+ mesh
+ ),
+ mesh,
+ dimensionedScalar("dpdt", p.dimensions()/dimTime, 0)
+ );
+
+ Info<< "Creating field kinetic energy K\n" << endl;
+ volScalarField K("K", 0.5*magSqr(U));
diff --git a/applications/solvers/heatTransfer/thermoFoam/setAlphaEff.H b/applications/solvers/heatTransfer/thermoFoam/setAlphaEff.H
new file mode 100644
index 00000000000..90b475794b6
--- /dev/null
+++ b/applications/solvers/heatTransfer/thermoFoam/setAlphaEff.H
@@ -0,0 +1,93 @@
+ Info<< "Creating turbulence model\n" << endl;
+ tmp<volScalarField> talphaEff;
+
+ IOobject turbulenceHeader
+ (
+ "turbulenceProperties",
+ runTime.constant(),
+ mesh,
+ IOobject::MUST_READ
+ );
+
+ IOobject RASHeader
+ (
+ "RASProperties",
+ runTime.constant(),
+ mesh,
+ IOobject::MUST_READ
+ );
+
+ IOobject LESHeader
+ (
+ "LESProperties",
+ runTime.constant(),
+ mesh,
+ IOobject::MUST_READ
+ );
+
+ if (turbulenceHeader.headerOk())
+ {
+ autoPtr<compressible::turbulenceModel> turbulence
+ (
+ compressible::turbulenceModel::New
+ (
+ rho,
+ U,
+ phi,
+ thermo
+ )
+ );
+
+ talphaEff = turbulence->alphaEff();
+ }
+ else if (RASHeader.headerOk())
+ {
+ autoPtr<compressible::RASModel> turbulence
+ (
+ compressible::RASModel::New
+ (
+ rho,
+ U,
+ phi,
+ thermo
+ )
+ );
+
+ talphaEff = turbulence->alphaEff();
+ }
+ else if (LESHeader.headerOk())
+ {
+ autoPtr<compressible::LESModel> turbulence
+ (
+ compressible::LESModel::New
+ (
+ rho,
+ U,
+ phi,
+ thermo
+ )
+ );
+
+ talphaEff = turbulence->alphaEff();
+ }
+ else
+ {
+ talphaEff = tmp<volScalarField>
+ (
+ new volScalarField
+ (
+ IOobject
+ (
+ "alphaEff",
+ runTime.timeName(),
+ mesh,
+ IOobject::NO_READ,
+ IOobject::NO_WRITE
+ ),
+ mesh,
+ dimensionedScalar("0", dimMass/dimLength/dimTime, 0.0)
+ )
+ );
+ }
+
+ const volScalarField& alphaEff = talphaEff();
diff --git a/applications/solvers/heatTransfer/thermoFoam/thermoFoam.C b/applications/solvers/heatTransfer/thermoFoam/thermoFoam.C
new file mode 100644
index 00000000000..f5f88232d2c
--- /dev/null
+++ b/applications/solvers/heatTransfer/thermoFoam/thermoFoam.C
@@ -0,0 +1,107 @@
+/*---------------------------------------------------------------------------*\
+ ========= |
+ \\ / F ield | OpenFOAM: The Open Source CFD Toolbox
+ \\ / O peration |
+ \\ / A nd | Copyright (C) 2013 OpenFOAM Foundation
+ \\/ M anipulation |
+-------------------------------------------------------------------------------
+License
+ This file is part of OpenFOAM.
+
+ OpenFOAM is free software: you can redistribute it and/or modify it
+ under the terms of the GNU General Public License as published by
+ the Free Software Foundation, either version 3 of the License, or
+ (at your option) any later version.
+
+ OpenFOAM is distributed in the hope that it will be useful, but WITHOUT
+ ANY WARRANTY; without even the implied warranty of MERCHANTABILITY or
+ FITNESS FOR A PARTICULAR PURPOSE. See the GNU General Public License
+ for more details.
+
+ You should have received a copy of the GNU General Public License
+ along with OpenFOAM. If not, see <http://www.gnu.org/licenses/>.
+
+Application
+ thermoFoam
+
+Description
+ Evolves the thermodynamics on a forzen flow field
+
+\*---------------------------------------------------------------------------*/
+
+#include "fvCFD.H"
+#include "rhoThermo.H"
+#include "turbulenceModel.H"
+#include "RASModel.H"
+#include "LESModel.H"
+#include "radiationModel.H"
+#include "fvIOoptionList.H"
+#include "simpleControl.H"
+#include "pimpleControl.H"
+
+// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+int main(int argc, char *argv[])
+{
+ #include "setRootCase.H"
+
+ #include "createTime.H"
+ #include "createMesh.H"
+ #include "createFields.H"
+ #include "createFvOptions.H"
+ #include "createRadiationModel.H"
+
+ // * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
+
+ Info<< "\nEvolving thermodynamics\n" << endl;
+
+ if (mesh.solutionDict().found("SIMPLE"))
+ {
+ simpleControl simple(mesh);
+
+ while (simple.loop())
+ {
+ Info<< "Time = " << runTime.timeName() << nl << endl;
+
+ while (simple.correctNonOrthogonal())
+ {
+ #include "EEqn.H"
+ }
+
+ Info<< "ExecutionTime = " << runTime.elapsedCpuTime() << " s"
+ << " ClockTime = " << runTime.elapsedClockTime() << " s"
+ << nl << endl;
+
+ runTime.write();
+ }
+ }
+ else
+ {
+ pimpleControl pimple(mesh);
+
+ while (runTime.run())
+ {
+ runTime++;
+
+ Info<< "Time = " << runTime.timeName() << nl << endl;
+
+ while (pimple.correctNonOrthogonal())
+ {
+ #include "EEqn.H"
+ }
+
+ Info<< "ExecutionTime = " << runTime.elapsedCpuTime() << " s"
+ << " ClockTime = " << runTime.elapsedClockTime() << " s"
+ << nl << endl;
+
+ runTime.write();
+ }
+ }
+
+ Info<< "End\n" << endl;
+
+ return 0;
+}
+
+
+// ************************************************************************* //
--
GitLab