Skip to content
GitLab
Commit da6820c3 authored by Andrew Heather's avatar Andrew Heather
Browse files

ENH: Added Pawan's sineWaveDamping tutorial to test new acousticDamping fvOption

parent a60b1ddd
Expand all Hide whitespace changes
Inline Side-by-side
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/0/T 0 → 100755
View file @ da6820c3
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: plus |
| \\ / A nd | Web: www.OpenFOAM.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
location "0";
object T;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 0 0 1 0 0 0];
internalField uniform 300;
boundaryField
{
inlet
{
type fixedValue;
value uniform 300;
}
outlet
{
type inletOutlet;
inletValue uniform 300;
value uniform 300;
}
frontAndBack
{
type empty;
}
}
// ************************************************************************* //
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/0/U 0 → 100755
View file @ da6820c3
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: plus |
| \\ / A nd | Web: www.OpenFOAM.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volVectorField;
location "0";
object U;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [0 1 -1 0 0 0 0];
internalField uniform (0 0 0);
boundaryField
{
inlet
{
type zeroGradient; // pressureInletVelocity;
value uniform (0 0 0);
}
outlet
{
type pressureInletOutletVelocity;
value uniform (0 0 0);
}
frontAndBack
{
type empty;
}
}
// ************************************************************************* //
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/0/p 0 → 100755
View file @ da6820c3
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: plus |
| \\ / A nd | Web: www.OpenFOAM.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class volScalarField;
location "0";
object p;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
dimensions [1 -1 -2 0 0 0 0];
internalField uniform 101325;
boundaryField
{
inlet
{
type uniformFixedValue; // oscillatingFixedValue;
uniformValue sine;
uniformValueCoeffs
{
amplitude constant 1;
frequency constant 3000;
scale constant 50;
level constant 101325;
}
value $internalField;
}
outlet
{
type waveTransmissive;
gamma 1.4;
fieldInf 101325;
lInf 2.25;
value uniform 101325;
}
frontAndBack
{
type empty;
}
}
// ************************************************************************* //
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/Allclean 0 → 100755
View file @ da6820c3
#!/bin/sh
cd ${0%/*} || exit 1 # Run from this directory
# Source tutorial clean functions
. $WM_PROJECT_DIR/bin/tools/CleanFunctions
cleanCase
#------------------------------------------------------------------------------
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/Allrun 0 → 100755
View file @ da6820c3
#!/bin/sh
cd ${0%/*} || exit 1 # Run from this directory
# Source tutorial run functions
. $WM_PROJECT_DIR/bin/tools/RunFunctions
runApplication blockMesh
runApplication $(getApplication)
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/constant/thermophysicalProperties 0 → 100644
View file @ da6820c3
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: 2.3.1 |
| \\ / A nd | Web: www.OpenFOAM.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "constant";
object thermophysicalProperties;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
thermoType
{
type hePsiThermo;
mixture pureMixture;
transport sutherland;
thermo hConst;
equationOfState perfectGas;
specie specie;
energy sensibleEnthalpy;
}
mixture
{
specie
{
nMoles 1;
molWeight 28.9;
}
thermodynamics
{
Cp 1007;
Hf 0;
}
transport
{
As 1.4792e-06;
Ts 116;
}
}
// ************************************************************************* //
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/constant/turbulenceProperties 0 → 100644
View file @ da6820c3
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: plus |
| \\ / A nd | Web: www.OpenFOAM.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "constant";
object turbulenceProperties;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
simulationType laminar;
// ************************************************************************* //
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/system/blockMeshDict 0 → 100644
View file @ da6820c3
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: plus |
| \\ / A nd | Web: www.OpenFOAM.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
object blockMeshDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
convertToMeters 1;
vertices
(
(-1.25 -0.01 -0.01)
(1.25 -0.01 -0.01)
(1.25 0.01 -0.01)
(-1.25 0.01 -0.01)
(-1.25 -0.01 0.01)
(1.25 -0.01 0.01)
(1.25 0.01 0.01)
(-1.25 0.01 0.01)
);
blocks
(
hex (0 1 2 3 4 5 6 7) (1000 1 1) simpleGrading (1 1 1)
);
edges
(
);
boundary
(
inlet
{
type patch;
faces
(
(0 4 7 3)
);
}
outlet
{
type patch;
faces
(
(1 2 6 5)
);
}
frontAndBack
{
type empty;
faces
(
(0 1 5 4)
(3 7 6 2)
(0 3 2 1)
(5 6 7 4)
);
}
);
mergePatchPairs
(
);
// ************************************************************************* //
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/system/controlDict 0 → 100644
View file @ da6820c3
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: plus |
| \\ / A nd | Web: www.OpenFOAM.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "system";
object controlDict;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
application rhoPimpleFoam;
startFrom startTime;
startTime 0;
stopAt endTime;
endTime 0.02;
deltaT 2e-6;
writeControl runTime;
writeInterval 0.0002;
purgeWrite 0;
writeFormat ascii; // binary;
writePrecision 16;
writeCompression off;
timeFormat general;
timePrecision 6;
runTimeModifiable true;
adjustTimeStep no;
maxCo 0.3;
maxDeltaT 1;
functions
{
fieldAverage
{
type fieldAverage;
functionObjectLibs ("libfieldFunctionObjects.so");
outputControl outputTime;
fields
(
U
{
mean on;
prime2Mean off;
base time;
}
p
{
mean on;
prime2Mean off;
base time;
}
);
}
}
// ************************************************************************* //
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/system/fvOptions 0 → 100644
View file @ da6820c3
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: plus |
| \\ / A nd | Web: www.OpenFOAM.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "system";
object fvOptions;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
acousticDampingSource
{
type acousticDampingSource;
active yes;
acousticDampingSourceCoeffs
{
timeStart 0.004;
duration 1000.0;
selectionMode all;
centre (-1.25 0 0);
radius1 1.2;
radius2 1.65;
frequency 3000;
URef UMean;
}
}
//************************************************************************* //
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/system/fvSchemes 0 → 100644
View file @ da6820c3
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: plus |
| \\ / A nd | Web: www.OpenFOAM.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "system";
object fvSchemes;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
ddtSchemes
{
default backward;
}
gradSchemes
{
default Gauss linear;
}
divSchemes
{
default none;
div(phi,U) Gauss linearUpwind grad(U);
div(phi,K) Gauss linear;
div(phi,h) Gauss limitedLinear 1;
div(((rho*nuEff)*dev2(T(grad(U))))) Gauss linear;
}
laplacianSchemes
{
default Gauss linear orthogonal;
}
interpolationSchemes
{
default linear;
}
snGradSchemes
{
default no;
}
wallDist
{
method meshWave;
}
// ************************************************************************* //
tutorials/compressible/rhoPimpleFoam/laminar/sineWaveDamping/system/fvSolution 0 → 100644
View file @ da6820c3
/*--------------------------------*- C++ -*----------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: plus |
| \\ / A nd | Web: www.OpenFOAM.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
FoamFile
{
version 2.0;
format ascii;
class dictionary;
location "system";
object fvSolution;
}
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
solvers
{
p
{
solver PCG;
preconditioner DIC;
tolerance 1e-08;
relTol 0.01;
}
pFinal
{
$p;
relTol 0;
}
"rho.*"
{
$p;
tolerance 1e-05;
relTol 0;
}
"(U|h)"
{
solver smoothSolver;
smoother symGaussSeidel;
tolerance 1e-08;
relTol 0.01;
}
"(U|h)Final"
{
$U;
relTol 0;
}
}
PIMPLE
{
momentumPredictor yes;
nOuterCorrectors 7;
nCorrectors 1;
rhoMax 1.5;
}
// ************************************************************************* //
Supports Markdown
0% or .
You are about to add 0 people to the discussion. Proceed with caution.
Finish editing this message first!
Please register or to comment